Skip to the content
2 layers29.5 × 29 mmOpenrz67-nrf, the printed circuit board in 3D

Bluetooth remote release for the Mamiya RZ67: ESP32-C3 firmware, KiCad PCB and enclosure. Shutter, bulb and countdown from your phone.

Size
29.5 × 29 mm
Copper layers
2
Thickness
1.6 mm
Parts
15
Nets
44
Pads
82
Tracks, vias
66, 13
Pours
4
Routed
Yes
KiCad
KiCad 10.0 (file 20260206)
Created
1 Jan 2023
Updated
4 Nov 2026

Overview

Openrz67-nrf is an open-source printed circuit board by mhellevang, from the mhellevang/openrz67-trigger repository on GitHub, published under the MIT licence. It is a 2-layer board of 29.5 × 29 mm with 15 parts on 44 nets, routed with 66 tracks and 13 vias.

It is built around the E73-2G4M08S1F, TLP172AM(E and CL31A107MQHNNNE, with the AO3401A, B3U-1000P and MY-2032-16 among its other parts. Its parts include 3 capacitors, 3 resistors, 3 ICs, 2 connectors and 1 diode. It belongs with the radio and wireless boards and the ESP32 and RISC-V boards of this library.

Main components

8

README

nrf/kicad/README.md

openrz67 nRF52 PCB — KiCad project

KiCad 10 project for the coin-cell trigger: 29.5 × 29 mm, 2 layers, Ebyte E73-2G4M08S1F (nRF54L15) module, CR2032 clip on the back, two TLP172AM PhotoMOS relays, JST SH 1.0 mm side-entry camera connector, a second SH connector for SWD, one button, one LED, a P-MOSFET against a reversed cell. No regulator, no charger, no power switch. Concept stage, not fabricated.

The schematic and the board are generated: tools/design.py holds parts, placement, nets and every track, and the two generators write the KiCad files from it. Edit the model and run tools/regen.sh; do not edit the .kicad_sch / .kicad_pcb by hand, the next run overwrites them.

FileWhat
tools/design.pythe design: parts with LCSC numbers, positions, nets, tracks, vias, keepout
tools/gen_sch.pywrites openrz67-nrf.kicad_sch: one symbol per part, a global label on every used pin, a no-connect on every unused one
tools/gen_pcb.pywrites openrz67-nrf.kicad_pcb with pcbnew: footprints, nets, outline, GND pours, antenna keepout, tracks, design rules
tools/regen.shruns both generators, then exports everything in out/ and runs DRC (with schematic parity) and ERC
tools/fetch_3d.shdownloads STEP+WRL models for every LCSC part in the BOM into openrz67-nrf.3dshapes/
tools/module_3d.pybox model of the E73 module (none on LCSC or from Ebyte): uv run tools/module_3d.py
tools/export_step.shboard STEP to out/openrz67-nrf.step (gitignored); fetches missing part models first
openrz67-nrf.3dshapes/3D models; .wrl committed (renders), .step gitignored except the module's
openrz67-nrf.kicad_sym, openrz67-nrf.pretty/project libraries: LCSC/EasyEDA imports via easyeda2kicad and KiCad's R
out/generated: Gerber+drill zip, position file, BOM with LCSC numbers, schematic PDF, top/bottom renders, DRC/ERC reports

Regenerate

sh
tools/regen.sh

Close KiCad first. Needs kicad-cli and KiCad's bundled python (for pcbnew); override with KICAD_CLI=… KICAD_PY=…. It exits non-zero on any DRC/ERC error or unconnected pad.

Circuit

The cell (VBAT) feeds the module through Q1, an AO3401A P-MOSFET with its drain on the clip, source on VDD and gate on GND. The right way round the body diode conducts until the channel turns on (under 85 mΩ at VGS = −2.5 V, about 1 mV at 15 mA). A cell put in upside down leaves it off, so VDD never goes negative. The module has one supply pad (9, 1.8–3.6 V per Ebyte; the nRF54L15 itself starts at 1.75 V) and both crystals inside. 100 µF sits at the clip terminal, ahead of Q1 (a ceramic, a reversed cell does not harm it), 100 nF right at module pad 9 (C3, ground straight to pad 10) and 100 nF at Q1/SWD (C2). Each PhotoMOS LED is driven from a GPIO through 220 Ω: about 4 mA at 2.7 V with the worst-case LED forward voltage, the TLP172AM needs up to 3 mA. The status LED has 1 kΩ (about 1 mA). With a fresh cell both relays and the LED draw about 14 mA, inside Nordic's recommended 15 mA sustained total for all GPIOs. The PhotoMOS outputs go to the camera connector; camera ground (CAM_GND) is a separate net from the cell's GND. J1 has the camera port's pin order, so the camera cable is wired straight through. Pigtail wire colours vary; go by pin position, pin 1 is next to the white dot.

nRF54L15Module padFunction
P1.047button to GND, internal pull-up, wake from System OFF
P2.0018status LED through 1 kΩ
P2.0427S1 PhotoMOS LED through 220 Ω
P2.0528S2 PhotoMOS LED through 220 Ω
SWCLK / SWDIO11 / 12J2 pins 3 / 4
nRESET19not brought out; reset over SWD

The button has to be on P0 or P1: P2 cannot wake the chip from System OFF. The three outputs run at high drive (S0H1) so the PhotoMOS LEDs get their 5 mA. The left pad column faces the board edge; VDD (pad 9) and the button (pad 7) leave it on two tracks between the module and the edge.

Connectors:

RefPinSignal
J1 camera, SH 1.0 mm (Qwiic/STEMMA QT cable)1not connected (camera 6 V)
2camera ground
3S1
4S2
J2 SWD, SH 1.0 mm (Qwiic cable to the probe)1GND
2VDD. With the cell out, the probe's 3.3 V powers the board here. Never with the cell in: it would charge the CR2032
3SWCLK
4SWDIO

Design rules

Clearance 0.127 mm, min track 0.127, default track 0.20 (signals 0.16, power 0.25), via 0.45/0.25, hole-to-track 0.175, hole-to-hole 0.30, copper-to-edge 0.30, mask expansion 0.051. JLCPCB silkscreen minimums (1.0 mm text, 0.15 mm line). A rule area over the module antenna (x 0–15, y 0–5.3) keeps copper, tracks and vias off both layers.

Accepted warnings

DRC and ERC have 0 errors. The warnings left in the reports:

CheckCountWhat
ERC endpoint_off_grid17Pins of the imported symbols are not on the 1.27 mm grid. Connectivity is by label; verified by the schematic-parity DRC.
silk_over_copper11The holder footprint's own silkscreen crosses its centre pad. Fab clips it.

Mechanical

Outline 29.5 × 29 mm, R0.8 corners, no mounting holes. All parts on top except the cell clip on the back. Module antenna end is flush with the top edge (y = 0); both SH connectors sit along the bottom edge with their mouths facing it (y = 29), SWD left of camera (the SWD cable is a lid-off job, no wall opening); the button sits bottom-left, the LED between the two connectors.

PartHeight over the board
CR2032 clip BT1 (back)3.75 mm, the cell under it; cell centre (13.5, 18), slides in from either long side
J1 camera and J2 SWD connectors2.9 mm, body 6.0 × 4.3 each
Module U12.4 mm (Ebyte drawing)

BT1 is only the positive clip (MYOUNG drawing: "TERMINAL(+)"). The cell's negative face rests on the Ø10 mm bare pad in the middle of the back. It has no paste, so the cell rests on the pad's finish, not on a solder dome with flux on it. On the back a copper-free ring 7.5 to 10.2 mm from the cell centre lies under the cell's rim, where the + can wraps over the edge; inside the ring only GND copper, the same potential as the cell face resting on it. Ebyte's manual gives no antenna keepout figure; the rule area covers the PCB antenna (the module's top 5.2 mm) plus 2 mm to its right. The module's 3D model is a plain box from tools/module_3d.py: blue PCB with the antenna, grey shield.

Parts

15
QtyValueFootprintReferences
2100nFopenrz67-nrf:C0402C2, C3
2220Ωopenrz67-nrf:R0402R1, R2
2TLP172AMopenrz67-nrf:SMD-4_L4.6-W3.7-P2.54-LS7.0-BRU2, U3
1100uFopenrz67-nrf:C1206C1
11kΩopenrz67-nrf:R0402R3
1AO3401Aopenrz67-nrf:SOT-23Q1
1B3U-1000Popenrz67-nrf:KEY-SMD_B3U-1000PMSW1
1CR2032openrz67-nrf:BAT-SMD_MY-2032-16BT1
1Cameraopenrz67-nrf:CONN-SMD_4P-P1.00_SM04B-SRSS-TB-LF-SNJ1
1E73-2G4M08S1Fopenrz67-nrf:WIRELM-SMD_E73-2G4M08S1FU1
1LEDopenrz67-nrf:LED0603-RDD1
1SWDopenrz67-nrf:CONN-SMD_4P-P1.00_SM04B-SRSS-TB-LF-SNJ2

Similar boards

  • 4 layers100 × 90 mmOpentouch s3, the printed circuit board in 3D

    Opentouch s3

    JoeMighty/opentouch-s3

    A modern remake of the Bare Conductive Touch Board: 12 capacitive touch electrodes, MP3/WAV/MIDI audio, and now WiFi, Bluetooth LE, USB-C, a proper LiPo power path, a fuel gauge, line-in, MIDI out, Qwiic and an RGB LED.

    185 parts
  • 2 layers91 × 55 mmMEISHI, the printed circuit board in 3D

    MEISHI

    YukiYuigishi/MEISHI

    46 parts1MIT
  • 4 layers17.8 × 33 mmNrf54l smol, the printed circuit board in 3D

    Nrf54l smol

    picafe/nrf54l_smol

    Ebyte E73-2G4M08S1F nRF54L15-based dev board with similar form factor to Pro Micro/Supermini

    29 parts
  • 4 layers60 × 60 mmE73-2G4M08S1F nRF54L15, the printed circuit board in 3D

    E73-2G4M08S1F nRF54L15

    plushugh/breakout_E73-2G4M08S1F_nRF54L15

    Ebyte E73-2G4M08S1F breakout board

    32 parts
  • 4 layers31.4 × 31 mmEsp32c6 ble sensor, the printed circuit board in 3D

    Esp32c6 ble sensor

    xmyoot/esp32c6-ble-sensor-coin-cell

    Ultra-compact 4-layer circular BLE sensor pod with ESP32-C6, CR2032 coin-cell power and environmental sensors

    71 parts
  • 2 layers45 × 35 mmEasyTester RevE, the printed circuit board in 3D

    EasyTester RevE

    kanengomibako/Modules

    66 parts4Unlicense
  • 2 layers34 × 32.5 mmDyno, the printed circuit board in 3D

    Dyno

    drewradcliff/dyno

    Finger strength dynamometer

    21 partsMIT
  • 6 layers40 × 40 mmKestrel fc, the printed circuit board in 3D

    Kestrel fc

    HeyPCB/kestrel-fc

    Kestrel H7: STM32H743 FPV flight controller with ICM-20602 + BMI088, MS5611, 16 MB blackbox, 5 V and switchable 10 V BECs.

    114 partsCERN-OHL-S-2.0

Questions

How big is the Openrz67-nrf PCB?

It measures 29.5 × 29 mm and has 2 copper layers, 1.6 mm thick.

What parts does the Openrz67-nrf use?

15 parts, built around the E73-2G4M08S1F, TLP172AM(E, CL31A107MQHNNNE and AO3401A. The full list of its parts is on this page, with links to each part's symbol and footprint where PCBKit's library has them.

Where can I download the Openrz67-nrf KiCad files?

From the mhellevang/openrz67-trigger repository on GitHub, at the commit this page was made from: the board is nrf/kicad/openrz67-nrf.kicad_pcb and its schematic nrf/kicad/openrz67-nrf.kicad_sch. PCBKit opens the board in the browser, with nothing to install.

Can I use the Openrz67-nrf design in my own project?

Its repository publishes it under the MIT licence: you may reuse it on that licence's terms (keep the author's notice, and for a copyleft licence share your changes alike).