Skip to the content
4 layers20 × 30 mmWiFi UART Bridge v3, the printed circuit board in 3D

Open-source ESP32-C3 UART to Wi-Fi bridge: firmware (ESP-IDF), KiCad 10 board, datasheet. Two UART lines relayed to UDP/TCP as whole frames, station or AP with DHCP, control over Kogger SBP, OTA with rollback.

Size
20 × 30 mm
Copper layers
4
Thickness
1.2 mm
Parts
41
Nets
32
Pads
156
Tracks, vias
561, 82
Pours
13
Routed
Yes
KiCad
KiCad 10.0 (file 20260206)
Created
27 Sep 2026
Updated
6 Nov 2026

Overview

WiFi UART Bridge v3 is an open-source printed circuit board by koggertech, from the koggertech/Kogger_UART_WiFi_Bridge repository on GitHub, published under the MIT licence. It is a 4-layer board of 20 × 30 mm with 41 parts on 32 nets, routed with 561 tracks and 82 vias.

It is built around the ESP32-C3-MINI-1U-H4, LMZM23601V3SILR and BAS 3005B-02V H6327, with the CL21A226MAYNNNE, SDM4A40EP3-7B and SM04B-GHS-TB(LF)(SN) among its other parts. Its parts include 12 diodes, 11 resistors, 8 capacitors, 2 ICs and 2 crystals. It belongs with the interfaces and adapters and radio and wireless boards and the ESP32 and RISC-V boards of this library.

Main components

9

README

hardware/README.md

Hardware: Wi‑Fi UART bridge board v3

KiCad 10 project of the reference board, the board that was manufactured and is in use. Every drill hole and every solder‑paste opening of this board matches the fabrication files the board was made from (checked, see below).

Board, top Board, bottom

FileContents
WiFi_UART_Bridge_v3.kicad_proproject (open this in KiCad 10 or later)
WiFi_UART_Bridge_v3.kicad_schschematic, one A4 sheet
WiFi_UART_Bridge_v3.kicad_pcbboard: 20 × 30 mm, 4 layers
WiFi_UART_Bridge.kicad_sym, WiFi_UART_Bridge.pretty/project symbol and footprint libraries (sym-lib-table, fp-lib-table)
3d/plain box bodies for renders (module, switch, 4 A diodes); other parts use KiCad library models
outputs/WiFi_UART_Bridge_v3_schematic.pdfschematic
outputs/WiFi_UART_Bridge_v3_fab.zipGerbers, Excellon drill, drill map, Gerber job file, pick‑and‑place, BOM
outputs/WiFi_UART_Bridge_v3_bom.csv, _pos.csvBOM and pick‑and‑place (top side, mm, origin at the lower‑left board corner)

The outputs are generated by python tools/make_hw_outputs.py (needs kicad-cli of KiCad 10).

Board

Size20 × 30 mm, a 2 mm wide, 4 mm deep notch with a rounded end between the two connectors
PCB4 layers, FR4 1.2 mm, 18 µm copper, ENIG finish, green solder mask, white silkscreen
Stackup in the filenominal: 0.2 mm prepreg, 0.708 mm core, 0.2 mm prepreg; use the fab's standard 1.2 mm 4‑layer stackup
LayersF.Cu: signals and GND pour; In1.Cu: GND; In2.Cu: VCC, +3.3 V and UART routing plus a GND pour; B.Cu: GND pour and the test pads
Design rulestrack 0.2 mm min, clearance 0.2 mm, vias 0.7/0.3 mm (82), copper to edge 0.25 mm
Components37 on the top side; 4 test pads on the bottom

Circuit

  • Module U1: ESP32‑C3‑MINI‑1U with a U.FL connector for an external 2.4 GHz antenna. The EN pin has a 10 kΩ pull‑up and 1 µF to GND (power‑on delay). The strapping pins GPIO2, GPIO8 and GPIO9 have 10 kΩ pull‑ups. The BOOT button SB1 pulls GPIO9 low.
  • Power:
    • VCC arrives on X1 pin 4 through the Schottky diode D9 (SDM4A40EP3, reverse‑polarity protection).
    • The step‑down module U2 (TI LMZM23601V3: 4–36 V in, 3.3 V out, up to 1 A per TI) makes +3.3 V.
    • VCC range: 4.5–24 V (rated; not measured on a board). The lower limit is the regulator's 4 V plus the diode drop; the upper limit stays below the 25 V rating of the input capacitors C5/C6.
  • X2 pin 4 (VCC_X2): two 0 Ω links. R8 connects it to VCC. R9 + D8 feed it from +3.3 V through a Schottky diode. Both links are fitted in the BOM, so X2 pin 4 carries VCC; with R8 left out it carries about 3 V. Through R8 the board can also be powered from X2 pin 4, without the reverse‑polarity diode.
  • UART protection: each line has a series resistor on the connector side, 150 Ω on TX and 1 kΩ on RX. On the module side, Schottky diodes (BAS3005B‑02V) clamp each line to GND and to a clamp rail 3.3S. D1 feeds that rail from +3.3 V; the 3.3 V Zener D12 and C4 absorb the clamp current, so over‑voltage on a connector does not pump up +3.3 V.
  • LED VD1: GPIO0 → 1 kΩ → green LED → GND, lit when GPIO0 is high. Since 0.20 the firmware shows the link on it (docs/HARDWARE.md).
  • Test pads on the bottom (1.6 mm): TP1 DM (GPIO18, USB D−), TP2 DP (GPIO19, USB D+), TP3 TX and TP4 RX of line 1 (GPIO5/GPIO4). The USB pads allow flashing through the C3's USB Serial/JTAG.
ConnectorPin 1Pin 2Pin 3Pin 4
X1 (line 0)TX (GPIO21)RX (GPIO20)GNDVCC in (through D9)
X2 (line 1)TX (GPIO5)RX (GPIO4)GNDVCC_X2

X1 and X2 are JST GH 4‑pin headers, 1.25 mm, right angle (SM04B‑GHS‑TB). The mating housing is GHR‑04V‑S. The bottom silkscreen names the pins.

How the KiCad project was checked

  1. Board:
    • footprints in one project library with plain names;
    • courtyards on U1, U2, X1, X2 and SB1 and fab outlines on U2, X1, X2 and SB1; the passives, diodes and LED have silkscreen outlines only, the test pads none (the board's DRC does not require courtyards);
    • footprints linked to their schematic symbols by UUID;
    • KiCad library 3D models, aligned by fitting the library footprint's pads onto these pads (residual ≤ 0.1 mm), plus three plain boxes;
    • stackup 1.2 mm, 18 µm copper, ENIG, green solder mask, white silkscreen;
    • drill/place origin at the lower‑left corner.
  2. Connectivity: the schematic netlist and the board partition all 134 pins into the same 32 nets. The only board pads without a symbol pin are 14 unconnected NC pads of U1.
  3. Against the fabrication files of the manufactured board:
    • all 82 drill holes match (≤ 0.0005 mm);
    • all 152 top and 4 bottom solder‑paste openings match in position (≤ 0.0004 mm) and size;
    • in the original pick‑and‑place file 33 of 37 parts match exactly. For D8, D9, X1 and X2 that file gives a body centre instead of the footprint origin; their pads are among the matched paste openings.
  4. ERC: clean. DRC with schematic parity: no parity errors, no unconnected items, no clearance errors. Remaining items are inherited from the original layout:
    • 1 error: C3 pad 2 has a single thermal spoke into the top GND pour after the zones are refilled;
    • 26 warnings: silkscreen text 0.7 mm high, below KiCad's default minimum of 0.8 mm;
    • 3 warnings: silkscreen over copper.

Changes to the content of the original design, all visible in the files:

  • The four bottom test pads were free pads in the original layout. They are now test points TP1–TP4 in the schematic and on the board, excluded from the BOM and the pick‑and‑place.
  • PWR_FLAG symbols and a "Power flags for ERC" block were added, as KiCad's ERC requires. U2's DNC and PGOOD pins got no‑connect marks.
  • Part data come from the production BOM: value, manufacturer part number, manufacturer. Fields of the original part database (stock, storage location, local datasheet paths, distributor links) were not carried over.
  • The original schematic's database item for D1, D3, D4, D6, D7, D10, D11, D13, D14 was SDM05A30CP3‑7. The production BOM and the footprint (SC‑79) use BAS3005B‑02VH6327, and so does this project.
  • ERC ignores "off grid" in this project: the ESP32 module symbol has its pins on a 2.5 mm pitch.
  • The board's copper‑to‑edge constraint is 0.25 mm: the layout keeps connector mounting pads (at 0.25 mm), stitching vias and a few tracks 0.25–0.48 mm from the edge.
  • Solder mask: green in this project; the first production run of board v3 used blue.
  • A duplicate set of connector labels outside the board outline on the front silkscreen was removed.

License

The hardware design files are published under the same MIT license as the rest of the repository (../LICENSE). KiCad library symbols embedded in the schematic, the symbol VCC_X2 of the project library (derived from KiCad power:VCC) and the KiCad 3D models the board refers to are covered by the KiCad libraries' license (../THIRD_PARTY.md).

The KOGGER logo on the bottom silkscreen of the board is not licensed under the MIT License. The fab zip in hardware/outputs includes it: before making boards that KOGGER LLC does not supply, delete the logo from B.SilkS and regenerate the outputs with tools/make_hw_outputs.py.

Parts

41
QtyValueFootprintReferences
9BAS3005B-02VWiFi_UART_Bridge:D_SC-79D1, D3, D4, D6, D7, D10, D11, D13, D14
410kWiFi_UART_Bridge:R_0603_1608Metric_BigR1, R3, R4, R5
30.1uFWiFi_UART_Bridge:C_0603_1608Metric_BigC2, C4, C8
31kWiFi_UART_Bridge:R_0603_1608Metric_BigR2, R10, R11
20WiFi_UART_Bridge:R_0603_1608Metric_BigR8, R9
210uFWiFi_UART_Bridge:C_0603_1608Metric_BigC1, C7
2150WiFi_UART_Bridge:R_0603_1608Metric_BigR6, R7
222uFWiFi_UART_Bridge:C_0805_2012MetricC5, C6
2SDM4A40EP3WiFi_UART_Bridge:D_SDM4A40EP3D8, D9
2SM04B-GHS-TBWiFi_UART_Bridge:JST_GH_SM04B-GHS-TB_1x04-1MP_P1.25mm_HorizontalX1, X2
11uFWiFi_UART_Bridge:C_0603_1608Metric_BigC3
1DMWiFi_UART_Bridge:TestPoint_Pad_D1.6mmTP1
1DPWiFi_UART_Bridge:TestPoint_Pad_D1.6mmTP2
1ESP32-C3-MINI-1UWiFi_UART_Bridge:ESP32-C3-MINI-1UU1
1LED greenWiFi_UART_Bridge:LED_0603_1608MetricVD1
1LMZM23601V3WiFi_UART_Bridge:TI_SIL0010A_LMZM2360xU2
1MMSZ5226BWiFi_UART_Bridge:D_SOD-123D12
1PTS525SM15SMTR2WiFi_UART_Bridge:SW_CK_PTS525SM15SMTR2SB1
1RXWiFi_UART_Bridge:TestPoint_Pad_D1.6mmTP4
1TXWiFi_UART_Bridge:TestPoint_Pad_D1.6mmTP3

Similar boards

  • 4 layers193 × 105.2 mmAFE V3, the printed circuit board in 3D

    AFE V3

    Pgr18/CELL_Z_SPECT_hardware

    Печатные платы для проекта клеточной импедансной спектроскопии

    293 parts
  • 6 layers36.5 × 36.5 mmH743 Ardupilot, the printed circuit board in 3D

    H743 Ardupilot

    OliviezGit/FC_01

    Le dossier composants contient les fiches techniques PDF, bibliothèques locales, STEP, vues de contrôle et la nomenclature France du 27/09/2026.

    156 partsCERN-OHL-S-2.0
  • 2 layers35 × 40 mmFemto tester v1, the printed circuit board in 3D

    Femto tester v1

    mfolejewski/FEMTO

    FEMTO - RP2040 12x12mm PCB module

    78 parts159
  • 2 layers64.8 × 25.5 mmPORTABLE ECG MACHINE, the printed circuit board in 3D

    PORTABLE ECG MACHINE

    jeis-aj/PORTABLE-ECG

    A Handheld ECG Machine with Mobile phone and Laptop interface. Cardiac condition prediction using ML

    92 partsMIT
  • 2 layers89.9 × 17.8 mmBivalveBit, the printed circuit board in 3D

    BivalveBit

    millerlp/BivalveBit_hardware

    Heart rate and valve gape sensor wearable for oysters and mussels

    58 partsGPL-3.0
  • 2 layers40.6 × 16.3 mmQFN, the printed circuit board in 3D

    QFN

    Paschalis/Hardware-Login-Key

    The Hardware Login Key is an ATtiny85-based USB device that securely automates password entry using a physical button or touch sensor. It offers a simple, hardware-driven way to log into systems or websites.

    15 parts3GPL-3.0
  • 2 layers60 × 75 mmOSRO, the printed circuit board in 3D

    OSRO

    dragonlock2/OSRO

    Just another open-source reflow oven

    52 parts11Apache-2.0
  • 4 layers37.5 × 30 mmDehydration reminder, the printed circuit board in 3D

    Dehydration reminder

    Adityawadpalliwar/smart-hydration-reminder-PCB

    A compact, low-power, wireless-capable PCB designed to live in a water bottle base or sleeve. It detects when you drink using a 6-axis IMU, keeps a running record of intake events, and reminds you with a buzzer when you…

    39 parts

Questions

How big is the WiFi UART Bridge v3 PCB?

It measures 20 × 30 mm and has 4 copper layers, 1.2 mm thick.

What parts does the WiFi UART Bridge v3 use?

41 parts, built around the ESP32-C3-MINI-1U-H4, LMZM23601V3SILR, BAS 3005B-02V H6327 and CL21A226MAYNNNE. The full list of its parts is on this page, with links to each part's symbol and footprint where PCBKit's library has them.

Where can I download the WiFi UART Bridge v3 KiCad files?

From the koggertech/Kogger_UART_WiFi_Bridge repository on GitHub, at the commit this page was made from: the board is hardware/WiFi_UART_Bridge_v3.kicad_pcb and its schematic hardware/WiFi_UART_Bridge_v3.kicad_sch. PCBKit opens the board in the browser, with nothing to install.

Can I use the WiFi UART Bridge v3 design in my own project?

Its repository publishes it under the MIT licence: you may reuse it on that licence's terms (keep the author's notice, and for a copyleft licence share your changes alike).