
Rpi pico printer board
jackw01/pi-pico-printer-board
Tinkerer-friendly Klipper compatible 3D printer control board using Raspberry Pi Pico

PCB design for the evoone BMS
EVO2513 is an open-source printed circuit board by evosonic, from the evosonic/evoone-bms-pcb repository on GitHub. It is an 8-layer board of 110 × 69 mm with 271 parts on 171 nets, routed with 1,595 tracks and 1,474 vias.
It is built around the TLV9002IDSGR, DMT4011LFG and BSS138, with the QTLP600C4TR, B340A and DT1240V3-04LP among its other parts. Its parts include 113 resistors, 58 capacitors, 21 transistors, 10 diodes and 6 connectors. It belongs with the power boards of this library.
KiCad project for the EvoOne battery management board, EVO2513 revision 0.6.0.
Revision 0.6.0 is the 0.5.0 design (the boards in field test) with the W16
review changes below. The project, schematic and PCB files are named
EVO2513; the project libraries keep their EVO2513-0_5_0 names.
The design was converted to KiCad from the Altium sources supplied by Lattech. The raw import needed several fixes before the schematic and PCB agreed; see Fixes after import.
| Outline | 110 × 69 mm |
| Layers | 8 copper (F.Cu, In1–In6.Cu, B.Cu) |
| Thickness | 1.598 mm finished (1.59 mm laminate + ENIG); stackup as the Altium fab drawing: three 0.25 mm cores, 2116 prepregs, 1 oz copper |
| Components | ~230 footprints |
| Tool | KiCad 10.0 |
The schematic is hierarchical: the root sheet EVO2513.kicad_sch holds
one sheet symbol per sheet, and each sheet is its own file. Open it from
EVO2513.kicad_pro.
| Sheet | Function | Key parts |
|---|---|---|
| S01 External Connectors | Board connectors, mounting and test points | J1–J6, TP1–TP26 |
| S02 Input Protection | Over/under-voltage and reverse-voltage protection on the input | LTC4365, DMT4011LFG N-FETs |
| S03 BMS Input and Output Monitor | Input/output current sensing and power-path switching | LTC1960, DMP3018SFV P-FETs, 2512 shunts |
| S04 Charger Regulation | Charger switching stage | LTC1960, L1 4.7 µH |
| S05 Battery Management | Dual-battery selection and management | LTC1960 |
| S06 STEP-Up Step-Down Reg | Buck-boost output regulator | LM51772, L2 0.68 µH |
| S07 Load Switch and I-Sense | Output load switches and current-sense amplifiers | TPS22811 ×3, TLV9002 ×2 |
| S08 IO Expander | SPI I/O expander driving the rail enables and reading the faults | PCAL9714 |
The LTC1960 dual battery charger/selector is a single IC (U1) split across sheets S03–S05.
Nets that cross sheets leave each sheet through a hierarchical label and a
pin on its sheet symbol, and the root sheet joins the pins with local
labels. There are no global labels; those nets are named from the root
(/DCBMS, /POS1, …). Labels between device sheets show the direction of
power or signal flow (e.g. DCFILTERED is an output of S02 and an input to
S03); links to the connector sheet, S01, stay passive. Labels used on only one sheet are local, and power
nets use power symbols.
| Ref | Part |
|---|---|
| J1 | Molex 1053101204, 2.5 mm pitch |
| J2 | Molex 1053101114, 14-way 2.5 mm pitch, vertical |
| J3 | Amphenol BergStak 10144517-043802LF, 40-pin 0.8 mm receptacle |
| J4 | Molex 1053102204, 2.5 mm pitch |
| J5, J6 | Molex 1053091102, 2-way 2.5 mm pitch |
The thermistor nets on J3 pins 24 and 28 are deliberately swapped from the
Altium design. The swap went in with 6ce5d68, whose commit message doesn't
mention it. Firmware written for the earlier pinout must swap its BMSTEMP and
REGTEMP channels.
| J3 pin | Altium design | Now |
|---|---|---|
| 24 | BMSTEMP (TH1) | REGTEMP (TH2) |
| 28 | REGTEMP (TH2) | BMSTEMP (TH1) |
EVO2513.kicad_pro — projectEVO2513.kicad_sch — root schematic sheet; S0x *.kicad_sch — the
eight sheetsEVO2513.kicad_pcb — PCB layoutFIRMWARE_NOTES.md — what the MCU firmware must know about this revision:
SPI and expander set-up, the inverted DAQ enable, load-switch thresholds and
current-monitor scalingEVO2513-0_5_0-import-fps.pretty/ — project footprint library (footprints
extracted by the Altium import), registered in fp-lib-table. Chip resistors
and capacitors, the small diodes and the LEDs instead use KiCad's
standard libraries (Resistor_SMD, Capacitor_SMD, Diode_SMD, LED_SMD,
Package_TO_SOT_SMD, Package_DFN_QFN)EVO2513-0_5_0-lattech.kicad_sym — project symbol library (nickname
Lattech Systems): the Lattech symbols used by the board, extracted from
the schematics, plus the PCAL9714 added for the W16 changes. It is not the complete Lattech library, which was not supplied.
Resistors and capacitors use KiCad's standard Device:R, Device:C and
Device:C_Polarized symbols, with value, footprint and part number in the
symbol fields, so a value change needs no new symbolEVO2513-0_5_0-altium-import.kicad_sym — the 4 power symbols created by the
Altium import. Both symbol libraries are registered in sym-lib-table.Part and value changes from the W16 schematic review. None changes a connection or the board copper.
| Ref | Was | Now | Why |
|---|---|---|---|
| Q1, Q3 | DMT4011LFG 40 V | DMT6007LFGQ-7 60 V | Margin against D1's clamp voltage |
| D1 | 1.5SMB27CA | 1.0SMBJ26CA (Diotec) | Stand-off above the 24 V supply; 42.1 V clamp |
| L1 | 4.7 µH SRP1265A-4R7M | 10 µH SRP1265A-100M | LTC1960's 10 µH minimum |
| C10 | 100 nF 16 V | 100 nF 50 V CC0402KPX7R9BB104 | Sits on VPLUS at ~23 V |
| R54 | 1 kΩ | 768 Ω RC0402FR-07768RL | SBC load-switch current limit (R22, R53, R71 stay 1 kΩ) |
| C16 | 220 nF 50 V C0G 0805 | 220 nF 50 V X7R CC0805KFX7R9BB224 | No 220 nF C0G 0805 exists |
| C39 | 470 pF | 1 nF | SW2 snubber, boost-mode ringing |
| C3, C11, C12 | 35 V | 50 V | DCFILTERED / DCBMS at 26.3 V |
| C44, C45, C48–C50, C54 | 16 V | 50 V | +12 V and the switched outputs |
| R1 | 620K (description 619K) | 619K | Value and description now agree |
| C2 | 100 µF (part number 35SVPF82M) | 82 µF 35SVPF82M | Matches the ordered part |
| C46, C47, C51 | 4.7 nF 50 V X7R 0402 | 1.8 nF 50 V X7R 0402 CC0402KRX7R9BB182 | TPS22811 DVDT caps (U6, U7, U9): shorter output ramp, as ordered for C47; the loads have little capacitance |
| R24–R27 | 10 Ω | 0 Ω | Pack comms pass straight through; protection moves to the MCU board |
| D9, D10 | DT1240V3-04LP fitted | DNP | Go with R24–R27: wrong clamp level for 3.3 V, and the protected MCU is on another board |
| R14 | 0.01 Ω | 0.012 Ω Yageo PA2512FKE7W0R012E | Adapter limit 8.33 A, below the 9.2 A supply, so charging throttles before the supply trips |
| R36 | 61.9K fitted | DNP | VIN-FB goes to ground through R37, as required when PCM is unused |
| R59, R61, R76 / R60, R62, R77 | 1M / 130K | 390K / 51K | TPS22811 PGTH dividers: 10.38 V threshold, string current 23.5 µA at threshold to meet TI's 20× PGTH leakage rule, so pin leakage can't push it near the rail |
| R67, R68, R81 | 2.2K | 4.7K | PG LED (LED2–LED4) resistors from +3V3MCU: about half the current, ≈0.25 mA each instead of ≈0.55 mA, which saves ≈0.9 mA on battery with all three rails up. 4.7K is already on the BOM (R10) |
| R90–R92, R101 | 1M | 1.07M | OVLO trip 14.0 V, so a tripped switch recovers on the 12.03 V rail; R101 shares the BOM line |
| U6 EN/UVLO | ENDAQ from P0_0, R49 100K pull-down | R108 619K / R49 75K UVLO divider, Q24 shutdown FET with R109 1.07M / R110 390K gate bias; net nENDAQ, active low | DAQ 11 V undervoltage lockout (W16 handoff §4.4) |
| R41, R45 | 2.2R 1% 1206, 1/4 W | 2.2R 1% 1210, 1/2 W (any standard thick film) | Snubber resistors. R41 (SW1) dissipates 0.31 W at 24 V and 0.38 W at the 26.3 V OV trip, 75% of 1/2 W: fine up to about 90 °C local ambient. R45 (SW2) 0.167 W, 33%. Power is set by C·V²·f, not the load, so it is continuous at 1.157 MHz; power-save mode lowers it at light load. Same length as 1206; the pads are 0.45 mm wider each side |
| Q4, Q5, Q12–Q15 | DMP3018SFV, PowerDI3333-8 (Type UX), imported Altium land | DMP3007SCG-13 (Diodes, V-DFN3333-8 Type B, 6.8 mΩ max at −10 V), Diodes_PowerDI3333-8, copied from KiCad's standard Package_SON library into the project library so it can carry the source-drain keepout | PowerPath/battery FET thermal margin (W16 handoff). KiCad has no Type B footprint; the PowerDI3333-8 one matches Diodes' Type B suggested land except 0.1 mm more toe on each pad row, and adds segmented paste on the drain. Its drain is one pad, 5, so the project symbol DMP3007SCG V-DFN3333-8 numbers D pins 5–8 and EP_D all 5. VGSS ±25 V as before. Diodes' datasheet (DS38990 rev 3-2) is still marked Advance Information |
| Q18 | CSD17304Q3 | unchanged (kept) | The W16 handoff suggested a lower-RDS(on) 30 V part for the 1.83 W boost-mode loss. Kept: it works and 15 units are in field test. Its thermal margin depends on copper: 46 °C/W on 1 in² against 158 °C/W on a minimum pad, so give it the full copper area in layout |
| R16 | 0.005R 2512 (CRE2512-FZ-R005E-3) | 0.003R Bourns CRE2512-FZ-R003E-3 | The LTC1960 latching breaker (90–115 mV for 15 ms) moves from 18–23 A to 30–38 A. 12 V peak load is about 7.5 A SBC (90 W) + 2.5 A J3 + DAQ, over the handoff's ~11 A threshold, and QE29 packs at ~21 A would sit at 105 mV, inside the trip window. Dissipation at 21 A drops from 2.2 W to 1.3 W. R16 feeds only the breaker comparator (SCP/SCN) |
| R53, R71 | 1K | unchanged | DAQ and EXT current limits (6595/R = 6.6 A, up to 7.1 A) sit above J6/J5's single 6.5 A contact. Left at 1K: DAQ's final load isn't known (stand-in device today) and EXT is unused. A note on S07 says to raise them to 1.2K or more once the loads are known |
| D4 | Pins named as a series pair | Pins named for the fitted common-anode BAT54A | Drawing and wiring were already right |
Connection options on U5 (LM51772), as 0R 0402 links so either build can be fitted (lower right of S06): nRST stays on DCBMS in both BIAS builds.
| Pin | Fitted | DNP (alternative) |
|---|---|---|
| MODE (7) | R86 to GND: power-save mode (W16 review) | R87 back to VCC2/ILIMCOMP: forced PWM, as built before |
| BIAS (40) | R89 to +12V (U5's own output): the LM51772 datasheet's standard configuration (§7.3.5). VSMART runs the VCC2 regulator from the lower of VIN and BIAS once both exceed the switch-over threshold, so on the 24 V supply it drops from 12 V instead of 24 V; at start-up or with +12V shorted it falls back to VIN | R88 to DCBMS, as built on the field units |
U5 is configured over I2C by default, not by its CFG resistors (parts right of the MODE/BIAS links on S06):
| Ref | Part | Function in the I2C build (default) |
|---|---|---|
| R38 | 0R, CFG1 (ADDR/SLOPE, pin 9) to GND | Selects I2C at address 0x6A. 6.49K instead selects resistor configuration with slope compensation 1.0 |
| R104 | 0R, SDA/CFG3 (pin 5) to J3.34 MCU_ENDAQ | SDA to the MCU |
| R105 | 0R, SCL/CFG4 (pin 6) to J3.36 MCU_ENEXT | SCL to the MCU |
| R106, R107 | 10K to +3V3MCU | SDA and SCL pull-ups (pins rated to 5.8 V). 10K keeps edges slow for EMC and limits the bus to 100 kHz standard mode |
| R30, R29 | 5.1K and 1.87K to GND, DNP | CFG3/CFG4 for the resistor build; fitted, they would load the bus |
To return to the resistor build, remove R104–R107, change R38 to 6.49K and fit R29 and R30. J3.34 and J3.36 are also the direct-enable fallback through R97 and R98 (S08), so R97 and R98 stay unfitted while the I2C build is fitted. The MCU pins on J3.34/J3.36 must support I2C.
U5 starts from its register defaults, not the resistor settings, so firmware must write them before raising REGEN. They are latched for as long as DCBMS is up, since nRST is tied to DCBMS. Defaults that differ from the resistor build:
ILIM_THRESHOLD);
ILIMCOMP is tied to VCC2, so confirm the average current limit stays
disabledEN_CONST_TDEAD) defaults off; R30 (CFG3 setting 7)
turns it onOvervoltage lockout on the load switches U6, U7 and U9 (TPS22811, S07): a
1.07 MΩ 1% resistor (R90, R91, R92) from +12V to nEN/OVLO (pin 2), with the
existing 100K 1% pull-downs R51, R52 and R70. Each switch turns off above
14.0 V (13.40–14.69 V over the ±2% pin threshold, 1% resistors and ±0.1 µA pin
leakage) and turns back on below 12.75 V (12.23–13.41 V), so a tripped switch
always recovers on U5's 12.03 V output. (1 MΩ gave 13.2 V, recovering at
11.50–12.60 V, which might not.) To revert, leave R90–R92 unfitted.
The power-good dividers on PGTH are R59, R61 and R76 (390K) over R60, R62 and
R77 (51K): PG rises at 10.38 V (9.62–11.17 V worst case) and falls at 9.43 V
(8.71–10.22 V). They were 1M over 130K, but the ±1 µA PGTH leakage across 1M
could put the threshold at 11.84 V, within 0.2 V of the rail. TI sizes the
string for at least 20× the PGTH leakage (20 µA); 390K/51K carries 23.5 µA at
the threshold and 27 µA at 12 V, and only while the switch is on, because the
dividers hang off the switch outputs. 51K is already on the BOM.
Undervoltage lockout on the DAQ switch U6 only: R108 619K from +12V over R49
75K on EN/UVLO (pin 1) turns U6 on at 11.10 V (10.63–11.91 V, including
1% resistors, ±0.1 µA pin and 0.5 µA FET leakage) and off at 10.09 V
(9.69–10.89 V). TI asks for a pull-up of at least 350 kΩ on supplies above
5 V. 1M/120K would keep the 11.2 V point, but leakage across 1M puts the
worst-case turn-on at 12.24 V, above the rail; 619K and 75K are already on
the BOM and keep it under 12 V. The
TPS22811's fixed hysteresis makes the turn-off point about 9% below turn-on,
so 11 V has to be the turn-on point. Because the divider now holds EN/UVLO,
the enable goes through Q24 (BSS138) from EN/UVLO to GND, and the expander net
is nENDAQ, active low: high or floating (POR, expander in reset or
unpowered) turns Q24 on and puts U6 in shutdown; low releases EN/UVLO to the
divider. R109 1.07M / R110 390K bias the gate from +12V to 3.21 V (2.83 V at
10.6 V, 4.0 V worst case at the 14.7 V OVLO limit), so the channel stays off
when the MCU board is unpowered, and the gate stays under 5 V. The divider
draws 8.2 µA from +12V (it was 94 µA with 100K/27K), and both values are
shared with other BOM lines. The gate's source impedance is 286K, so P0_1 can
stay push-pull: driven high to 3.3 V it still holds Q24 on and sinks at most
2.4 µA, and the R97 fallback can drive it from a 3.3 V MCU pin. SBC and EXT have no
UVLO. A note on S07 marks the DAQ circuit as deliberate.
If the UVLO causes trouble, R115 (0R, DNP) bypasses it. Fit R115 and remove
Q24, R108 and R109: nENDAQ then drives EN/UVLO directly, as ENSBC and
ENEXT drive U7 and U9, so P0_1 (or the R97 fallback) becomes active high and
DAQ has no undervoltage lockout. R110 390K in parallel with R49 75K (62.9K) is
the pull-down that holds U6 off while the expander is in reset or unpowered.
Leaving R108 or R109 fitted with R115 would put a +12V divider on EN/UVLO, so
remove both.
Rail enables and faults through a PCAL9714 SPI I/O expander (U11, new sheet S08). It shares CLOCK/MOSI/MISO with U1 (LTC1960) and has its own chip select, nCSIO, on J3.32, the pin that was ENSBC. Address 40h (ADDR to GND); INT has a pull-up but isn't routed off the board. Both supplies are +3V3MCU. RESET is held low by R100 (100K) and pulled to +3V3MCU by Q23 (BSS138, the same FET as Q20-Q22) whenever +12V is up: R99 100K / R101 1.07M put about 11 V on its gate. With the 12 V rail off the expander is in reset with every port an input, and RESET can never rise above +3V3MCU, so nothing back-powers the expander. The switch point depends on Q23's gate threshold (roughly 3.5-4 V on +12V with a BSS138) and has no hysteresis, so firmware should wait for +12V before configuring the expander.
Q20–Q23 are onsemi BSS138 (SOT-23) in place of the DMN65D8LFB-7 (DFN1006, 1.0 × 0.6 mm). Use the plain BSS138 or another part without a gate protection zener: the gates sit on 100K pull-ups (R63, R65, R78) and the R99/R101 divider, and ESD-protected parts such as the 2N7002K or BSS138BK leak up to about 10 µA, which would pull the PG high level down by about 1 V. BSS138: IGSS 100 nA, IDSS 0.5 µA, VGS(th) 0.8–1.5 V.
| Port | Net | Function |
|---|---|---|
| P0_0 (out) | ENSBC | U7 enable |
| P0_1 (out) | nENDAQ | U6 enable through Q24, active low |
| P0_2 (out) | ENEXT | U9 enable |
| P0_4–P0_6 (in) | PGDAQ, PGSBC, PGEXT | U6, U7, U9 power good (also still drive the LEDs) |
| P0_7 (in) | nFLT | U5 nFLT/nINT, which was unconnected |
| P0_3, P1_0–P1_5 | — | spare, not connected |
REGEN (U5 enable, J3.12) stays separate: it is still driven straight from J3 and doesn't pass through the expander.
J3 pins 34 and 36 are now MCU_ENDAQ and MCU_ENEXT. Each reaches its
enable only through a DNP 0R link (R97, R98), and J3.32
nCSIO has R95 (fitted) to the expander CS and R96 (DNP) to ENSBC. To go
back to driving an enable straight from J3, fit its link and leave that
expander port an input. The expander powers up with every port an input
and pulls off, so the pull-downs (R50, R69) and Q24's gate bias keep the
rails off until firmware sets P0_0–P0_2 as outputs. R97 now lands on
nENDAQ, so an MCU driving DAQ directly must drive it low to enable. The MCU firmware must change for this:
the three load-switch enables move from GPIO to SPI, and nCSIO must idle high (R93
pulls it up).
These parts aren't on the board yet: run Update PCB from Schematic, then place and route R86–R110, Q23, Q24, U11, C58 and C59, and re-place Q20–Q22 (now SOT-23). The ENDAQ, ENSBC and ENEXT tracks from J3 need cutting at the new links.
Parts with the same value in different packages or ratings now share one BOM line. Each change keeps or raises the voltage rating and tolerance. All resistors are 1%: the OVLO dividers moved from 1M/102K 0.1% to 1.07M/100K 1% (see the overvoltage lockout above), and R101 is 1.07M to share their BOM line.
| Refs | Was | Now |
|---|---|---|
| C8, C9 | 1 µF 50 V X5R 0402 | 1 µF 50 V X5R 0603, as C23, C44, C45, C48–C50, C54 |
| C7, C52, C53, C58, C59 | 100 nF 16 V X7R 0402 | 100 nF 50 V X7R 0402 CC0402KPX7R9BB104, as C10 |
| C37, C38 | 100 nF 16 V X7R 0603 | the same, 0402 (U5 bootstrap caps, ~5 V) |
| C17, C18, C20, C21, C34 | 100 nF 50 V X7R 0402, no part number | CC0402KPX7R9BB104 |
| C11–C14, C24–C26 | 10 µF 25 V/50 V 1206 | 10 µF 50 V X7R 1210 Taiyo Yuden UMK325AB7106KMHP, as C27 (1210 is easier to source) |
| C27 | 10 µF 50 V X5R 1210 | the same part, X7R |
| C16 | 220 nF 50 V X7R 0805 | the same, 0603 Yageo AC0603KRX7R9BB224, as C22 (charger bootstrap cap) |
| C22 | 220 nF 50 V 0603, material field X5R | X7R, as its description already said |
| R43, R44 | 10R 1% 0603 | 10R 1% 0402, as R4, R5, R24–R27 (U5 current-sense filter, no power) |
Five U5 (LM51772) changes found during the review:
| Ref | Was | Now | Why |
|---|---|---|---|
| C30 → R102 | 22 µF 6.3 V 0603 on VCC1 | 10K 1% 0402 to GND, as R7 | VCC1 is disabled (R30 5.1K on CFG3); the datasheet says tie a disabled VCC1 to GND through a resistor, not leave it floating |
| C32 | 22 µF 6.3 V X5R 0603 on VCC2 | 22 µF 16 V X5R 0805 Murata GRM219R61C226ME15L | VCC2 needs 6 µF minimum; the 0603 keeps only about 5–7 µF at 5 V |
| R29 | 1.9K | 1.87K | CFG4 setting #3 accepts 1.814–1.926 kΩ (1.87K typical); 1.9K isn't a 1% value, and 1.91K can reach 1.929 kΩ |
| C61 (new) | — | 100 nF 50 V X7R 0402 CC0402KPX7R9BB104 (as C34), BIAS (pin 40) to GND, between R88 and R89 | BIAS had no local decoupling; TI's WEBENCH design puts 100 nF (Cbias) on it. The +12V caps are about 4.6 mm away through R89 |
| R46 (FB top) | on the power-stage side of R48 | on +12V, teed into the ISNSN Kelvin trace from R48's load-side pad | +12V is regulated after the 5 mΩ shunt, so it no longer sags by R48's drop (about 55 mV at 11 A). Matches the datasheet's Figure 9-1 and §9.9.1.3 (route the top feedback resistor to the output sense point). VOUT (pin 18) stays on the power stage |
Run Update PCB from Schematic to swap the footprints. Parts that grow overlap their neighbours' courtyards and need moving: the 0603s for C8 and C9 by up to 0.9 mm (C8 against R8, C9 against R15 and C10), the 1210s by about 0.15 mm (C11/C12/C27, C24/C26, C25 against C23), and C32 by 0.3 mm against C38 (before C38 shrinks to 0402) and 0.1 mm against TH2.
MANUFACTURER and MANUFACTURER_PN are filled on every fitted part, in the
schematic and on the board. Parts unchanged since 0.5.0 carry the exact part
numbers bought for the 0.5.0 backup build (DigiKey list for 20 boards, plus a
Mouser order for LM51772RHAR, DMT6007LFGQ-7 and DMT4011LFG-7). Parts that
changed reuse a bought part where value, package and rating match (for
example the 390K/51K PGTH dividers take the R9 51K part). Parts with no earlier
order keep the schematic's part number, or take a Yageo RC/CC-series part:
RC0402JR-070RL (0R), RC0402FR-07390KL, RC0402FR-071M07L,
RC0402FR-071K87L, RC1210FR-072R2L, CC0805KPX7R9BB102,
CC0603KRX7R9BB104. Resistors are standardised on Yageo (R31
RC0402FR-1340K2L, R111–R114 RC0603FR-073RL), except the current-sense
shunts R16, R19, R42 and R48. D6–D8 are B340A-13-F. M1–M6 have no manufacturer
fields; their value is the Würth part number.
Five lines use parts held in stock from the 0.5.0 orders, with the earlier
schematic part kept in the NOTE field as Alternate: <manufacturer> <part number>:
| Ref | Fitted part | Alternate (NOTE) |
|---|---|---|
| C6 | Yageo CC0402KRX7R9BB182 1.8 nF 50 V X7R, as C46, C47, C51 | KEMET C0402C182K4RACTU |
| C8, C9, C23, C44, C45, C48–C50, C54 | Samsung CL10A105KB8NNNC 1 µF 50 V X5R 0603 | Murata GRT188R61H105KE13D (AEC-Q200) |
| C15 | KEMET C0805C475K8PACTU 4.7 µF 10 V X5R 0805 | Murata GRM219R61A475KE34J |
| D2 | MCC MBR0540-TP | Panjit SS0540_R1_00001 |
| L2 | Würth 744393580068 0.68 µH, on the XAL8080 footprint | Coilcraft XAL8080-681MEB |
Each fix is a separate commit on top of the initial import.
| Problem in the raw import | Fix |
|---|---|
Every symbol's Value field was ${ALTIUM_VALUE}, resolved through a per-symbol field | Copied the real value into Value (209 symbols); the 26 test points, which had no value, are POGO-1 |
| 12 Footprint fields differed from the placed footprint only in letter case, so library lookup failed | Fields now name the exact footprint used on the PCB (J2, J5, J6, M2–M6, FL1, D9, D10, L2) |
An imported FOOTPRINT field holding the bare package name (0402, SMA, …) overrode the real Footprint field, since KiCad matches field names case-insensitively | Renamed to ALTIUM_FOOTPRINT on all 237 symbols |
| Altium net labels became KiCad local labels, which don't connect across sheets, splitting 35 nets | Converted the 78 labels for those nets to global labels |
44 embedded library symbols drew Altium special strings =Value and =FootPrint as literal text | =Value replaced with ${VALUE}; =FootPrint replaced by showing each part's own ALTIUM_FOOTPRINT field in the same place, so parts show their part number and package as in Altium |
All 99 power symbols were unannotated (#PWR?) | Annotated #PWR1–#PWR99 |
| The "Lattech Systems" symbol library wasn't available, so symbols existed only as copies embedded in the schematics, some in several slightly different versions | Exported the symbols to project libraries under their original library names, and made every schematic use one definition per symbol |
| Chip resistor and capacitor footprints had poor pads (0402s used 0.635 mm circular pads) and caused tombstoning | Replaced all 139 with KiCad standard IPC-7351 nominal footprints (Resistor_SMD, Capacitor_SMD) in place: same position, rotation and nets, zones refilled |
| Diodes and LEDs used imported Altium lands where KiCad has a standard IPC-7351 footprint; the LED land carried A/C silk text below the minimum thickness (8 DRC warnings) | Swapped to KiCad standard footprints in place (same position, side and nets; pad centres within 0.33 mm): D1 Diode_SMD:D_SMB, D6–D8 Diode_SMD:D_SMA, D4 Package_TO_SOT_SMD:SOT-23 (as Q20–Q24), D9/D10 Package_DFN_QFN:Diodes_UDFN-10_1x2.5mm_P0.5mm (identical pads), LED1–LED4 LED_SMD:LED_0603_1608Metric, turned 180° because its pad 1 (cathode) is on the other side. The SMA/SMB pads are 0.6–0.7 mm longer towards the body. The power FETs keep their imported lands: they match the manufacturers' suggested layouts, KiCad's equivalents number the whole drain as one pad, and Q18's land is proven on the field units. The five unused imported footprints are removed from the project library |
| PCB footprints were linked to the imported symbols by mismatched internal IDs, and nets used Altium names | Ran Update PCB from Schematic: no errors, placement and copper unchanged, all 147 nets match the schematic |
| KiCad design rules were defaults (0.2 mm clearance and track, 0.3 mm min hole), not the Altium rules | Set to the rules in the Altium .PcbDoc: 0.15 mm clearance, track and annular ring, 0.15 mm min hole, 0.3 mm hole-to-hole, and EVO2513.kicad_dru for the 0.3 mm pad-to-pad rule on test points TP1–TP26 |
The import turned 347 Altium copper regions into board graphic polygons (gr_poly) on B.Cu and In1–In6: a 1.2 × 1.8 mm octagon over each six-via block, on every layer. As drawings they bypass zone clearance and fill rules, and on the GND layers most were net islands in the GND pour, including the charger switch node (Net-(D2-C)) | Removed all of them. None carried current: each only joined its own vias, which every same-net pour already connects solid, and DRC finds 0 unconnected without them. GND gains about 26 mm² on In1, 21 mm² on In3 and In5, 18 mm² on In6 and 27 mm² on B.Cu |
| FL1's ground land had no pad number, so its 38 GND vias showed as shorts | Numbered pad 4 (GND) on the board and in the project footprint library |
| The two mounting holes and the logo existed only on the board, with no schematic symbols | H1 and H2 (Mechanical:MountingHole_Pad, pin 1 to GND, project footprint MountingHole_3.2mm_Pad_7.4mm) and LOGO01 (EVOSONIC_LOGO, a pinless symbol in the Lattech library) are on the root sheet, excluded from BOM and position files. Update PCB from Schematic no longer deletes them |
| 14 zero-length track segments | Removed |
| FL1's courtyard had a centre cross drawn on F.CrtYd, so KiCad saw an open (malformed) courtyard | Moved the cross to F.Fab on the board and in the project footprint library |
| Two vias sat in 0402 pads (R13 pad 2, R54 pad 2), connected on F.Cu only, and could wick solder | Removed |
| 9 tracks ran within 0.15 mm of the new R/C pad corners, B.Cu tracks passed 0.10 mm from J2 pins 9/10, and the ENEXT track 0.21 mm from J3's peg hole | Rerouted; 15 small R/C parts and 3 GND vias moved 0.1 mm |
| Net class patterns named Altium's auto-generated nets, so 13 power nets were in the Default class | Patterns point at the current net names |
| Every sheet sat 43 mil off the 50 mil connection grid in Y | Shifted each sheet's contents 7 mil onto the grid, and moved the few remaining off-grid wire corners on S06 onto it |
| 9 wires ran past their labels, leaving dangling ends | Trimmed back to the label |
| GND, +12V, +3V3MCU and +5V had no power source for ERC | Added PWR_FLAG symbols |
Title blocks used the Altium formula ${COPY(DOCUMENTNAME,…)} for the sheet title | Replaced with each sheet's title |
Every resistor and capacitor had its own per-value Lattech symbol (76 of them), and the schematic showed the ALTIUM_VALUE field, not Value, so R1, C39 and R54 still displayed their old values | Swapped all 160 for KiCad's Device:R, Device:C and Device:C_Polarized (C2, C28, C40–C42) in place, connections unchanged; Value is now the displayed field, and the 76 symbols are gone from the project library. ALTIUM_VALUE brought in line with Value on R1, C39, R54, D1, Q1, Q3 and L1 |
The import made seven KiCad 10 top-level sheets, so kicad-cli only loaded S01, and every title block read "sheet 7 of 7" | Added a root sheet with the seven as sub-sheets (S01's content moved to S01 External Connectors.kicad_sch); sheet numbers now come from the page number |
Symbols still carry their imported Altium fields (ALTIUM_VALUE,
ALTIUM_FOOTPRINT, MANUFACTURER, MANUFACTURER_PN, …) for reference.
MECH SPACER WURTH 78614150960 THROUGH M3, also on the board): four
2 mm spokes at 0/90/180/270° across a 0.4 mm gap. These replace the four keepout
arcs inherited from Altium, which gave about 1.43 mm spokes and left dead copper
stubs wherever a sector faced the board edge or another net's pour. Spokes are
only drawn where they reach the pour, so M1–M5 have 2–3 per layer, as many live
connections as before, with about 40 % more connected copper. M6 sits between
the DCCHARGER and DCPATH pours, so it connects through In1 and B.Cu (4 spokes
each) and one spoke on In3, In5 and In6, where DRC's two-spoke minimum is
excluded. A rule in EVO2513.kicad_dru keeps other nets' pours 0.45 mm from M6.EVO2513.kicad_dru also keeps other nets' pours 0.3 mm from those FETs' pads. Both
protect the source-drain gap during rework.EVO2513.kicad_dru gives every footprint
marked DNP a −50 mm paste margin, so its stencil apertures drop out of F.Paste.
Clearing a part's DNP flag restores its paste. KiCad has no plot option for this.nENDAQ) and pad 1 to the
EN/UVLO track from R108.Generated outputs (netlists, backups, per-user .kicad_prl settings) are not
tracked; see .gitignore.
| Qty | Value | Footprint | References |
|---|---|---|---|
| 26 | POGO-1 | EVO2513-0_5_0-import-fps:TEST PIN 1-25mm SMD Pad (POGO-1) | TP1, TP2, TP10, TP11, TP12, TP13, TP14, TP15, TP16, TP17, TP18, TP19, TP20, TP21, TP22, TP23 +10 |
| 16 | 0R | Resistor_SMD:R_0402_1005Metric | R24, R25, R26, R27, R38, R86, R87, R88, R89, R95, R96, R97, R98, R104, R105, R115 |
| 14 | 100K | Resistor_SMD:R_0402_1005Metric | R3, R12, R18, R40, R50, R51, R52, R63, R65, R69, R70, R78, R99, R100 |
| 14 | 100nF | Capacitor_SMD:C_0402_1005Metric | C7, C10, C17, C18, C20, C21, C34, C37, C38, C52, C53, C58, C59, C61 |
| 12 | 10K | Resistor_SMD:R_0402_1005Metric | R7, R28, R55, R56, R72, R73, R75, R93, R94, R102, R106, R107 |
| 9 | 1uF | Capacitor_SMD:C_0603_1608Metric | C8, C9, C23, C44, C45, C48, C49, C50, C54 |
| 8 | 10uF | Capacitor_SMD:C_1210_3225Metric | C11, C12, C13, C14, C24, C25, C26, C27 |
| 6 | 100R | Resistor_SMD:R_0402_1005Metric | R15, R21, R64, R66, R79, R80 |
| 6 | 78614150960 | EVO2513-0_5_0-import-fps:MECH SPACER WURTH 78614150960 THROUGH M3 | M1, M2, M3, M4, M5, M6 |
| 6 | DMP3007SCG-13 | EVO2513-0_5_0-import-fps:Diodes_PowerDI3333-8 | Q4, Q5, Q12, Q13, Q14, Q15 |
| 6 | DMT4011LFG | EVO2513-0_5_0-import-fps:Power DI3333-8 B3.3 x 3.3 P0.65 Tab 8-Pin | Q6, Q7, Q8, Q9, Q10, Q11 |
| 5 | 1.07M | Resistor_SMD:R_0402_1005Metric | R90, R91, R92, R101, R109 |
| 5 | 51K | Resistor_SMD:R_0402_1005Metric | R9, R11, R60, R62, R77 |
| 5 | BSS138 | Package_TO_SOT_SMD:SOT-23 | Q20, Q21, Q22, Q23, Q24 |
| 5 | NEQ | Resistor_SMD:R_2512_6332Metric | R23, R82, R83, R84, R85 |
| 4 | 1.8nF | Capacitor_SMD:C_0402_1005Metric | C6, C46, C47, C51 |
| 4 | 10R | Resistor_SMD:R_0402_1005Metric | R4, R5, R43, R44 |
| 4 | 390K | Resistor_SMD:R_0402_1005Metric | R59, R61, R76, R110 |
| 4 | 3R | Resistor_SMD:R_0603_1608Metric | R111, R112, R113, R114 |
| 4 | 4.7K | Resistor_SMD:R_0402_1005Metric | R10, R67, R68, R81 |
| 4 | QTLP600C-4 | LED_SMD:LED_0603_1608Metric | LED1, LED2, LED3, LED4 |
| 3 | 180uF | EVO2513-0_5_0-import-fps:CAP Panasonic CASE-E12 | C40, C41, C42 |
| 3 | 1K | Resistor_SMD:R_0402_1005Metric | R22, R53, R71 |
| 3 | 21.5K | Resistor_SMD:R_0402_1005Metric | R57, R58, R74 |
| 3 | 5.1K | Resistor_SMD:R_0402_1005Metric | R6, R13, R30 |
| 3 | 619K | Resistor_SMD:R_0402_1005Metric | R1, R17, R108 |
| 3 | B340A | Diode_SMD:D_SMA | D6, D7, D8 |
| 3 | TPS22811 | EVO2513-0_5_0-import-fps:VQFN-HR B2.0x2.0x1.0 10-Pin TI LM73100RPW | U6, U7, U9 |
| 2 | 100pF | Capacitor_SMD:C_0402_1005Metric | C19, C57 |
| 2 | 1053091102 | EVO2513-0_5_0-import-fps:CONNECTOR MOLEX 1053091102 2POS 2.5MM THP | J5, J6 |
| 2 | 10k | Resistor_SMD:R_0603_1608Metric | TH1, TH2 |
| 2 | 2.2R | Resistor_SMD:R_1210_3225Metric | R41, R45 |
| 2 | 220nF | Capacitor_SMD:C_0603_1608Metric | C16, C22 |
| 2 | 5.62K | Resistor_SMD:R_0402_1005Metric | R37, R47 |
| 2 | 75K | Resistor_SMD:R_0402_1005Metric | R33, R49 |
| 2 | DMT6007LFGQ-7 | EVO2513-0_5_0-import-fps:Power DI3333-8 B3.3 x 3.3 P0.65 Tab 8-Pin | Q1, Q3 |
| 2 | DT1240V3-04LP | Package_DFN_QFN:Diodes_UDFN-10_1x2.5mm_P0.5mm | D9, D10 |
| 2 | Fiducial | EVO2513-0_5_0-import-fps:Fiducial-50 | Fiducial1, Fiducial2 |
| 2 | IAUCN04S7L019 | EVO2513-0_5_0-import-fps:Infineon_PG-TDSON-8-33_5.48x5.15mm_P1.27mm | Q16, Q19 |
| 2 | M3 | EVO2513-0_5_0-import-fps:MountingHole_3.2mm_Pad_7.4mm | H1, H2 |
| 2 | TLV9002IDSG | EVO2513-0_5_0-import-fps:WSON B2x2 P0-5 8-Pin EP | U8, U10 |
| 1 | 0.0015R | Resistor_SMD:R_2512_6332Metric | R42 |
| 1 | 0.003R | Resistor_SMD:R_2512_6332Metric | R16 |
| 1 | 0.005R | Resistor_SMD:R_2512_6332Metric | R48 |
| 1 | 0.012R | Resistor_SMD:R_2512_6332Metric | R14 |
| 1 | 0.015R | Resistor_SMD:R_2512_6332Metric | R19 |
| 1 | 0.68uH | EVO2513-0_5_0-import-fps:IND COILCRAFT XAL8080 | L2 |
| 1 | 1.0SMBJ26CA | Diode_SMD:D_SMB | D1 |
| 1 | 1.87K | Resistor_SMD:R_0402_1005Metric | R29 |
| 1 | 100nF | Capacitor_SMD:C_0603_1608Metric | C60 |
| 1 | 10144517-043802LF | EVO2513-0_5_0-import-fps:Connector Amphenol BergStak 10144517-043802LF 40-Pin Receptical | J3 |
| 1 | 1053101114 | EVO2513-0_5_0-import-fps:CONNECTOR MOLEX 1053101114 2.5MM THP | J2 |
| 1 | 1053101204 | EVO2513-0_5_0-import-fps:Connector Molex 105310xx04 4POS 2.5mm THP | J1 |
| 1 | 1053102204 | EVO2513-0_5_0-import-fps:Connector Molex 105310xx04 4POS 2.5mm THP | J4 |
| 1 | 10nF | Capacitor_SMD:C_0402_1005Metric | C5 |
| 1 | 10uF | Capacitor_SMD:C_0603_1608Metric | C56 |
| 1 | 10uH | EVO2513-0_5_0-import-fps:IND Bourns SRRP1265A | L1 |
| 1 | 110pF | Capacitor_SMD:C_0402_1005Metric | C36 |
| 1 | 120uF | EVO2513-0_5_0-import-fps:CAP Panasonic CASE-F12 | C28 |
| 1 | 12K | Resistor_SMD:R_0402_1005Metric | R2 |
| 1 | 13K | Resistor_SMD:R_0402_1005Metric | R34 |
| 1 | 15nF | Capacitor_SMD:C_0402_1005Metric | C33 |
| 1 | 180pF | Capacitor_SMD:C_0402_1005Metric | C31 |
| 1 | 1nF | Capacitor_SMD:C_0805_2012Metric | C39 |
| 1 | 1nF | Capacitor_SMD:C_0402_1005Metric | C4 |
| 1 | 2.2uF | Capacitor_SMD:C_1206_3216Metric | C3 |
| 1 | 2.7K | Resistor_SMD:R_0402_1005Metric | R35 |
| 1 | 22uF | Capacitor_SMD:C_0805_2012Metric | C32 |
| 1 | 22uF | Capacitor_SMD:C_1210_3225Metric | C43 |
| 1 | 27K | Resistor_SMD:R_0402_1005Metric | R39 |
| 1 | 3.6K | Resistor_SMD:R_0402_1005Metric | R20 |
| 1 | 4.22K | Resistor_SMD:R_0402_1005Metric | R32 |
| 1 | 4.7nF | Capacitor_SMD:C_0402_1005Metric | C1 |
| 1 | 4.7uF | Capacitor_SMD:C_0805_2012Metric | C15 |
| 1 | 40.2K | Resistor_SMD:R_0402_1005Metric | R31 |
| 1 | 470pF | Capacitor_SMD:C_0805_2012Metric | C35 |
| 1 | 61.9K | Resistor_SMD:R_0402_1005Metric | R36 |
| 1 | 62K | Resistor_SMD:R_0402_1005Metric | R46 |
| 1 | 680K | Resistor_SMD:R_0402_1005Metric | R8 |
| 1 | 68nF | Capacitor_SMD:C_0402_1005Metric | C29 |
The 253 most common of 271 parts.

jackw01/pi-pico-printer-board
Tinkerer-friendly Klipper compatible 3D printer control board using Raspberry Pi Pico


drandyhaas/HaasoscopePro
Affordable 2 GHz 3.2 GS/s 12 bit open-source open-hardware expandable USB real-time oscilloscope


Alia5/PiCCANTE
PiCCANTE is a powerful tool for exploring and reversing CAN busses of vehicles, based on Raspberry Pi Pico (any model)

Smoothieware/Smoothieboard2
Hardware files for the Smoothieboard v2, and extension boards

CuriousMotor/Onyx-Stepper-Motherboard
The successor of the iconic Arduino-CNC-shield

JohnDecebal/UNDR
UNDR AUTO is a fully automatic WDT (Weiss Distribution Technique) tool designed for espresso enthusiasts. This open-source DIY project combines 3D printed parts with electronic and mechanical components to create a…
It measures 110 × 69 mm and has 8 copper layers, 1.59 mm thick.
271 parts, built around the TLV9002IDSGR, DMT4011LFG, BSS138 and QTLP600C4TR. The full list of its parts is on this page, with links to each part's symbol and footprint where PCBKit's library has them.
From the evosonic/evoone-bms-pcb repository on GitHub, at the commit this page was made from: the board is EVO2513.kicad_pcb and its schematic EVO2513.kicad_sch. PCBKit opens the board in the browser, with nothing to install.
Its repository states no licence, so its author keeps all rights: ask evosonic before reusing the design.