Skip to the content
2 layers190 × 109 mmIOB v3.2.1, the printed circuit board in 3D

KiCad hardware repo for the UC-IP main PCB (currently: IOB board family). This README documents the review-and-release process used to get a schematic/PCB change from an engineer's desk to fabrication.

Size
190 × 109 mm
Copper layers
2
Thickness
1.6 mm
Parts
538
Nets
397
Pads
1,649
Tracks, vias
6,111, 1,130
Pours
2,073
Routed
Yes
KiCad
KiCad 10.0 (file 20260206)
Created
17 Aug 2026
Updated
19 Aug 2026

Overview

IOB v3.2.1 is an open-source printed circuit board by ADFTech, from the ADFTech/xtec-uc-ip-main-pcb repository on GitHub. It is a 2-layer board of 190 × 109 mm with 538 parts on 397 nets, routed with 6,111 tracks and 1,130 vias.

It is built around the BT136, 74LV245D and LM324, with the LM358, NCP3063D and MC74HC4051AD among its other parts. Its parts include 267 resistors, 81 capacitors, 70 transistors, 38 diodes and 31 ICs. It belongs with the STM32 boards of this library.

Main components

12

README

README.md

XTEC UC-IP Main PCB

KiCad hardware repo for the UC-IP main PCB (currently: IOB board family). This README documents the review-and-release process used to get a schematic/PCB change from an engineer's desk to fabrication.

Toolchain

  • KiCad CLI, run via Docker (no local KiCad install required):

    bash
    docker pull kicad/kicad:10.0.4
    
    alias kicad-cli-docker='docker run --rm -v "$(pwd)":/work -w /work kicad/kicad:10.0.4 kicad-cli'

    Run from inside the board's project folder (e.g. IOB/) so relative paths resolve. The container runs as uid 1000, so output files come back owned by your normal user — no chown needed on a typical single-user Linux dev machine.

  • GitHub Copilot — auto-reviews every PR that touches .kicad_sch / .kicad_pcb files, following the checklist in .github/skills/kicad-review/SKILL.md. Copilot refuses to review a PR once it exceeds ~20,000 changed lines, so keep raw Gerber/generated diffs out of the PR (see Repo conventions and .gitattributes/.gitignore) — Copilot should only ever be diffing the .kicad_sch/.kicad_pcb source and small docs.

  • Claude Code — run manually against the PR (diff, ERC/DRC delta, visual diff, stated intent) as a second automated pass before human sign-off. Unlike Copilot's PR review, Claude Code isn't limited by the PR's line count, so it can be pointed at the full local diff (including the raw gerber comparison) even when Copilot can't review the PR at all.

Review process

Every hardware change goes through the same loop: engineer submits → automated checks (Copilot + Claude) → human manual review → merge → DFM with the manufacturer. Either automated or manual review failing sends it back to the engineer; either automated or manual review passing is necessary but not sufficient — a human always signs off before merge, and DFM issues after merge also loop back.

mermaid
sequenceDiagram
    actor Eng as PCB Engineer
    actor You as You (Reviewer)
    participant Repo as Git Repo / GitHub
    participant CLI as KiCad CLI
    participant Copilot as GitHub Copilot
    participant Claude as Claude Code
    actor Mfg as Manufacturer (DFM)

    Eng->>You: Updated .kicad_sch / .kicad_pcb + description of change & test result

    You->>Repo: Copy files into tracked project folder

    You->>CLI: Regenerate ERC/DRC reports (JSON)
    CLI-->>You: erc_report.json, drc_report.json

    You->>CLI: Export gerbers/SVG, generate visual diff
    CLI-->>You: overlay / highlighted diff image

    You->>Repo: Commit files + reports + diff artifacts (message = engineer's description)
    You->>Repo: Open pull request

    Repo->>Copilot: Auto-trigger PR review
    Note over Copilot: Uses .github/skills/kicad-review/SKILL.md

Step by step

  1. Engineer submits a change. Updated .kicad_sch / .kicad_pcb files plus a description of what changed, why, and what they tested.
  2. Reviewer stages the files in the tracked project folder (IOB/, alongside the versioned filenames like IOB_v3.2.1.kicad_pcb).
  3. Regenerate reports via kicad-cli (see Toolchain) into IOB/Deliverables/:
    bash
    cd IOB/
    kicad-cli-docker sch erc IOB_v3.2.1.kicad_sch -o Deliverables/ERC_report.rpt
    kicad-cli-docker pcb drc IOB_v3.2.1.kicad_pcb -o DRC_report.rpt
  4. Export gerbers/drill and build a visual diff (before vs. after) into IOB/Gerber/ and changelog/:
    bash
    kicad-cli-docker pcb export gerbers IOB_v3.2.1.kicad_pcb -o Gerber/
    kicad-cli-docker pcb export drill IOB_v3.2.1.kicad_pcb -o Gerber/
    Old-vs-new gerber pairs for the visual diff go in changelog/gerber_<new>_v.<old>/ (e.g. changelog/gerber_v3.2.1_v.3.2.0/), named <Layer>_old.pho / <Layer>_new.pho. This folder is gitignored — it's regenerable, and each file can run 100K+ lines, which is what blows a PR past Copilot's review cap. Zip it (e.g. Gerber_old_vs_new.zip) and attach the zip to the PR instead of committing the raw files — see changelog/README.md.
  5. Update the changelog and peer checklist in changelog/ (Changelog X1-<board> <date>.xlsx, Internal Peer Checklist - X1_<board>.xlsx) — these are small and stay tracked in git.
  6. Commit and open a PR using the PR template — fill in the summary, testing, and files-changed checklist. Attach ERC/DRC reports and the zipped visual diff.
  7. Copilot auto-reviews the PR using .github/skills/kicad-review/SKILL.md — posts a plain-English changelog and flags.
  8. Run Claude Code against the PR (diff + ERC/DRC delta + visual diff + stated intent) for a second changelog and a ✅/⚠️/🛑 summary.
  9. Human manual review — cross-check both automated reviews against the actual diff images, verify mechanical fit/clearances/silkscreen/connector orientation, and confirm the stated test result actually supports the change.
  10. Merge or send back. Issues found → specific feedback to the engineer, loop back to step 1. Passed → approve and merge.
  11. DFM with the manufacturer. Send the fabrication package (IOB/Gerber/ + BOM from IOB/Deliverables/, plus pick-and-place). DFM issues → feedback to the engineer, loop back to step 1. DFM passed → proceed to fabrication.

Repo conventions

  • Each board family lives in its own top-level folder (e.g. IOB/) containing the KiCad project. Version is carried in the filenames (IOB_v3.2.1.kicad_pcb, IOB_v3.2.1.kicad_sch + numbered sheet files), not the folder name — the folder itself stays unversioned across revisions.
  • IOB/Deliverables/ holds generated exports for the current revision: PDF schematic print, BOM, ERC report, and the PCB↔schematic sync reports.
  • IOB/Gerber/ holds the current revision's fabrication output (gerbers + drill files).
  • Top-level changelog/ holds cross-revision artifacts: the changelog workbook and internal peer review checklist (tracked in git), plus gerber_<new>_v.<old>/ folders with old/new gerber pairs for visual diffing (not tracked — see changelog/README.md).
  • IOB/.history/ (KiCad's own local file-history backups) is gitignored — it's not project history, git is. Never commit it.
  • PR titles/descriptions should describe the engineering change and test result, not just "updated PCB" — both Copilot and Claude review against the stated intent, so a vague description gets flagged rather than rubber-stamped.
  • Every PR touching .kicad_sch or .kicad_pcb should include regenerated ERC/DRC reports so reviewers can diff violations before vs. after.
  • Keep PRs under Copilot's ~20,000-changed-line cap: commit only source files (.kicad_sch, .kicad_pcb) and small generated reports/docs. Raw Gerber diff folders and .history/ must never be committed (enforced by .gitignore); if a PR still exceeds the cap, rely on Claude Code's manual review pass and human review — Copilot review becomes best-effort only for oversized PRs.

Parts

538
QtyValueFootprintReferences
119RES0603R100, R101, R105, R106, R107, R108, R112, R113, R114, R115, R118, R120, R121, R125, R126, R128 +103
26C1815SOT23Q1, Q3, Q4, Q11, Q14, Q18, Q21, Q24, Q27, Q30, Q33, Q36, Q39, Q42, Q45, Q48 +10
24BAV99SOT23D1, D2, D12, D16, D21, D22, D23, D24, D25, D26, D27, D28, D29, D30, D31, D46 +8
22100nF0805C1, C3, C26, C28, C43, C49, C54, C56, C58, C60, C149, C150, C153, C155, C157, C159 +6
22AO3400SOT23Q12, Q15, Q19, Q22, Q25, Q28, Q31, Q34, Q37, Q40, Q43, Q46, Q49, Q52, Q55, Q58 +6
22AO3401SOT23Q10, Q13, Q16, Q17, Q20, Q23, Q26, Q29, Q32, Q35, Q38, Q41, Q44, Q47, Q50, Q53 +6
22L-EMI0603LB2, LB10, LB11, LB12, LB13, LB14, LB15, LB16, LB17, LB18, LB19, LB20, LB21, LB22, LB23, LB24 +6
21100nF0603C13, C14, C15, C17, C18, C35, C36, C37, C38, C111, C113, C131, C133, C134, C135, C138 +5
1810K 1%0603R1, R102, R109, R116, R123, R130, R137, R145, R213, R219, R272, R294, R305, R312, R319, R326 +2
16CAP0603C2, C16, C19, C20, C21, C22, C23, C24, C25, C27, C30, C31, C47, C130, C132, C148
14RES0805R36, R65, R110, R117, R131, R146, R225, R256, R266, R280, R287, R306, R313, R327
10200R0805R7, R75, R77, R79, R81, R83, R86, R88, R90, R92
10470KD07RV-SLR8, R76, R78, R80, R82, R84, R87, R89, R91, R93
10BT136SL-TO-220A-AU3, U13, U14, U15, U16, U17, U19, U20, U21, U22
8110K 1%0603R11, R13, R166, R168, R174, R176, R182, R184
8120K0603R9, R10, R164, R165, R172, R173, R180, R181
8160R 1%0805R2, R103, R124, R153, R214, R273, R295, R320
82.2uF0603C6, C7, C101, C102, C103, C104, C105, C106
8226K 1%0603R12, R14, R167, R169, R175, R177, R183, R185
633R0603R27, R40, R41, R42, R43, R44
6LM324SO14NBU7, U34, U38, U42, U46, U50
6SL-CON-SIP12-200KF235-5.0-6PJ5, J10, J12, J31, J48, J51
6SL-CON-SIP5-200SS-HZ-12D07J1, J8, J11, J13, J14, J15
5100K0603R30, R135, R143, R150, R229
510K1%0603R3, R104, R111, R217, R226
51R0805R95, R96, R198, R199, R200
54.7K1%0603R5, R38, R119, R218, R258
547K0603R39, R127, R134, R149, R156
41.5nF0805C4, C5, C81, C82
410K0603R31, R62, R74, R85
4270R0805R15, R170, R178, R186
4330R 1%0805R16, R171, R179, R187
4LM358SO8NBU4, U24, U25, U26
4SMBJ24CASMB-1D3, D37, D38, D39
3DIODEDO-214AAD20, D41, D44
3SMBJ5.0CASMB-1D6, D8, D43
2SOT353-5U1, U23
2100K0805R207, R208
2100R0603R33, R46
2100pF0805C52, C116
2100uF/25VCAP2.6C50, C147
2100uHIND_HQRL1, L2
210K0805R6, R139
21K0603R221, R230
220pF0603C11, C12
24.7K0603R63, R122
25.1K0805R4, R138
274LV245SSOP20-2U2, U18
2MC74HC4051ADSO16NBU28, U35
2NCP3063SO8NBU29, U33
2RES1206R296, R301
2SL-CON-SIP10-200KF235-5.0-5PJ37, J38
2SL-CON-SIP6-200KF235-5.0-3PJ7, J33
2TVSSMB-1D4, D42
1FUS-BOXF3
10R0603R212
11.2K 1%0603R201
111K 1%0603R98
1120R/3A1206LB7
1120R/3A0603LB4
11K 1%0603R97
11R0805RR94
13.3K0603R45
13.6K 1%0603R202
1330uF/50VCAP5.0C32
1470uF/10VCAP2.5C112
18MXTAL_HC49SMTY1
1CAP+CAP2.6C29
1CAP+CAP5.0C8
1CD4051SO16NBU9
1CON-SIP4CON-SIP-4P-100J41
1HEAD-2PSIP-2P-100J4
1HEAD-4PCON-SIP-4P-100J45
1HEAD-4PX2SIP-4X2-100J6
1HEAD-5PCON-SIP-5P-100J23
1HEAD-7PX22.0MMX7X2_SMTJ9
1LED_GreenDIO-0805D48
1LED_RedDIO-0805D51
1LM117-3.3VSOT223U8
1STM32F103-144LQFP144-0.5U6

The 537 most common of 538 parts.

Similar boards

  • 2 layers100 × 100 mmHdmilight v3, the printed circuit board in 3D

    Hdmilight v3

    esar/hdmilight-v3

    HDMI Light v3 - FPGA based Ambilight clone with direct HDMI input

    259 parts8GPL-2.0
  • 2 layers100 × 100 mmTesseract, the printed circuit board in 3D

    Tesseract

    IoTCloudStudio/HW_Develop

    89 parts2
  • 2 layers55 × 80 mmBoard esp32 v2, the printed circuit board in 3D

    Board esp32 v2

    sudomesh/disaster-radio

    A (paused) work-in-progress long-range, low-bandwidth wireless disaster recovery mesh network powered by the sun.

    101 parts1.1k
  • 2 layers155.5 × 130 mmEinkpicframe, the printed circuit board in 3D

    Einkpicframe

    Spritetm/picframe_colepd

    A WiFi picture frame allowing for remote photo uploads, using an ESP32-C3 and a 5.6" color E-ink display

    60 parts97
  • 2 layers84.3 × 64.5 mmTapeshnik proto, the printed circuit board in 3D

    Tapeshnik proto

    svofski/tapeshnik

    compact cassette data drive

    138 parts14
  • 2 layers53 × 93 mmEink digit clk, the printed circuit board in 3D

    Eink digit clk

    Spritetm/eink_digit_clock

    Clock which uses E-ink panels as separate digits

    58 parts9
  • 2 layers95 × 100 mmCellDoc Nano, the printed circuit board in 3D

    CellDoc Nano

    mariofritzer/CellDoc

    Jeder Test legt die Zelle mit einer festen Nummer an. Die Nummer kommt mit einem Etikettendrucker auf die Zelle, der QR-Code darauf öffnet die Zelle später direkt in CellDoc.

    28 parts1MIT
  • 2 layers233.5 × 103 mmNailPrinter PCB, the printed circuit board in 3D

    NailPrinter PCB

    Novitech3D/Open-Nail-Printer

    An open-source nail art printer.

    37 parts

Questions

How big is the IOB v3.2.1 PCB?

It measures 190 × 109 mm and has 2 copper layers, 1.6 mm thick.

What parts does the IOB v3.2.1 use?

538 parts, built around the BT136, 74LV245D, LM324 and LM358. The full list of its parts is on this page, with links to each part's symbol and footprint where PCBKit's library has them.

Where can I download the IOB v3.2.1 KiCad files?

From the ADFTech/xtec-uc-ip-main-pcb repository on GitHub, at the commit this page was made from: the board is IOB/IOB_v3.2.1.kicad_pcb and its schematic IOB/IOB V3.2.1_sheet1.kicad_sch. PCBKit opens the board in the browser, with nothing to install.

Can I use the IOB v3.2.1 design in my own project?

Its repository states no licence, so its author keeps all rights: ask ADFTech before reusing the design.