Skip to the content
2 layers91.3 × 108 mmStrampler redesign v2 2, the printed circuit board in 3D

Strampler redesign v2 2

tungusk/strampler-build-pack

Build pack for the CTAG Strämpler (Antumbra 18HP redesign): Eagle + KiCad board files, BOMs with 2026 EOL fixes, fab/assembly package, DIY kit guide. CC BY-NC-SA.

Size
91.3 × 108 mm
Copper layers
2
Thickness
1.6 mm
Parts
174
Nets
110
Pads
592
Tracks, vias
1,923, 263
Pours
4
Routed
Yes
KiCad
KiCad 10.0 (file 20260206)
Created
7 Jul 2026
Updated
15 Sep 2026

Overview

Strampler redesign v2 2 is an open-source printed circuit board by tungusk, from the tungusk/strampler-build-pack repository on GitHub. It is a 2-layer board of 91.3 × 108 mm with 174 parts on 110 nets, routed with 1,923 tracks and 263 vias.

It is built around the CP2102N-EK, ESP32-WROVER-B and MCP6004-E/P, with the TL072, MCP3208-BI/P and SS8050-G among its other parts. Its parts include 61 resistors, 58 capacitors, 18 connectors, 12 ICs and 6 transistors. It belongs with the ESP32 boards of this library.

Main components

6

README

hardware-kicad/README.md

Editing the boards (KiCad 10+)

  • Main board + schematic: open project/Strampler_redesign_v2_2.kicad_pro — a full linked project (schematic, board, and the Eagle-imported symbol library). Footprints are embedded in the board, so it is self-contained.
  • Panel: open strampler_panel_v2_2.kicad_pcb directly in the PCB Editor. The artwork is ~34k filled polygons on F.Silkscreen; the copper pours are filled zones. It is heavy but edits fine.

After editing, regenerate all fab outputs (gerber zips + centroid) with:

text
./make-fab-files.sh

Both gerber sets passed PCBWay audit (2026-07) as generated by that script's commands.

Provenance & pitfalls

These files were converted from the Eagle 7.3 originals (../hardware-eagle/) with KiCad 10.0.4. Two importer pitfalls are already fixed here — beware if you ever re-import from Eagle instead of editing these files:

  1. The importer creates unfilled zones, which plot as EMPTY gerber layers (missing copper, mask and artwork). Fixed by filling copper zones and converting non-copper zones to filled gr_poly shapes.
  2. The importer maps Eagle's t/bRestrict layers to layer "UNDEFINED", which KiCad's own parser then refuses to load. The first fix remapped them to User.1 — which was itself a bug: User.1 is not a copper layer, so the 1876 tiny restrict rectangles did nothing and the copper pours filled straight under the LED light window. The 2026-07 panel run came back with a copper wave where the original has bare FR4 (found 2026-08-28 at first-module assembly). Fixed 2026-08-28: the 938 unique rectangles (identical to the F/B.Mask window polygons) were merged into one polygon and replaced by a single keep-out rule area on F.Cu + B.Cu (copperpour not_allowed, named "LED light window"); zones refilled; panel gerbers regenerated. Verified: filled copper ∩ window = 0 on both layers.

Main-board audit (2026-08-28) — keep-outs OK, one mask sliver restored

After the panel bug, the main board was checked for the same class of loss. Eagle's tRestrict/bRestrict circles (mounting holes of P3 TFT, jacks, PCB screws) and the vRestrict under the crystal all survived as proper rule areas inside the footprints (copperpour not_allowed on F.Cu/B.Cu; via keep-out on both). Verified with pcbnew: filled copper ∩ every keep-out = 0 (64 pairs). The only dropped item was a 0.15 × 1.3 mm tStop sliver in the SJ (solder jumper) package — the mask opening between SJ1's two pads that makes it bridgeable. Restored as an fp_rect on B.Mask (SJ1 is on the bottom); main gerbers regenerated. The fabbed 2026-07 main boards lack that sliver: SJ1 can still be bridged, it just takes a blob over the ~0.1 mm mask web. SJ1 joins ESP32 IO19 to TFT connector pin 9.

Panel v2_3 (2026-08-29) — M7 pot holes

strampler_panel_v2_3.kicad_pcb is the current panel: v2_2 plus the four CV pot holes and POT1's hole resized 9.2/8.2 → 7.2 mm for M7-bushing pots (Same Sky PTN091/PTN092 — see build-pack COMPLETION-SHOPPING §POT2–5). The other 8.2 mm hole is the ENCODER's — deliberately unchanged. make-fab-files.sh builds v2_3; v2_2 is kept as the pre-M7 version matching the five fabbed (LED-window-defective) panels.

Refilling zones from the command line

kicad-cli has no zone-fill command. After editing a board outside the GUI (e.g. scripted changes), refill with the bundled Python before running make-fab-files.sh:

text
PY=~/Applications/KiCad/KiCad.app/Contents/Frameworks/Python.framework/Versions/Current/bin/python3
$PY -c "import pcbnew; b=pcbnew.LoadBoard('strampler_panel_v2_2.kicad_pcb'); \
  pcbnew.ZONE_FILLER(b).Fill(b.Zones()); pcbnew.SaveBoard('strampler_panel_v2_2.kicad_pcb', b)"

(SaveBoard drops a stray .kicad_pro next to the panel — delete it.)

Verify against the Eagle originals and the render-main-*.png references before fabbing modified boards. License: CC BY-NC-SA 4.0 (see ../LICENSE.md).

Parts

174
QtyValueFootprintReferences
21100nFRESISTOR_0603C14, C16, C17, C18, C19, C20, C22, C27, C28, C29, C30, C33, C35, C37, C41, C44 +5
1510uFR0805C1, C2, C3, C11, C12, C13, C15, C21, C23, C24, C25, C26, C31, C32, C40
1410kRESISTOR_0603R3, R18, R20, R22, R23, R24, R25, R26, R27, R28, R29, R31, R36, R37
14THONKICONNPROTOJACKJ1, J2, J3, J4, J5, J6, J7, J8, J9, J10, J11, J12, J13, J14
10100kRESISTOR_0603R34, R35, R39, R41, R43, R45, R51, R53, R55, R57
81nFRESISTOR_0603C49, C50, C51, C52, C53, C54, C55, C56
6200kRESISTOR_0603R42, R44, R50, R52, R54, R56
65.6kRESISTOR_0603R6, R7, R14, R15, R16, R17
5PCB_SCREWPCB_SCREWH1, H2, H3, H4, H5
5SS8050-GSOT23Q2, Q3, Q4, Q5, Q6
4ALPS_POT_VERTICALPOT2, POT3, POT4, POT5
418pFRESISTOR_0603C4, C5, C7, C8
439kRESISTOR_0603R1, R2, R10, R11
466.5kRESISTOR_0603R48, R49, R60, R61
31uFRESISTOR_0603C6, C43, C45
322uF1206_POLC38, C39, C42
2SOD123D1, D2
2180kRESISTOR_0603R38, R40
21kRESISTOR_0603R12, R13
2220pFRESISTOR_0603C9, C10
222kRESISTOR_0603R4, R5
23.3kRESISTOR_0603R8, R9
233kRESISTOR_0603R58, R59
247kRESISTOR_0603R46, R47
2C&K_TACTILE_SWITCHC&K_TACTILE_SWITCHSW2, SW3
2FERRITE-BEAD0805R0805F1, F2
2MCP6004TSSOP14IC10, IC11
2TL072SOIC8IC2, IC3
1HC49UPQ1
1SJSJ1
1POT_DUAL_THONKPOT1
110R2512R30
11000uFPANASONIC_GC36
110uFR1210C34
122.1kRESISTOR_0603R19
1220RESISTOR_0603R33
147.5kRESISTOR_0603R21
168RESISTOR_0603R32
1ADP7118SOT23-5LIC7
1CP2102NCP2102NIC6
1ENCODERALPS_EC12E_SWSW1
1ESP32-WROVER-BESP32-WROVER-BIC5
1LED5MMLED_5MML1
1LM4040SOT23SOT23U1
1MCP3208SOIC16IC9
1MIC803SOT23IC1
1MSP2202_DISPLAYMSP2202_DISPLAYP3
1POWER_SIMPLE10POWER_10P4
1SD-CARDSD-CARD-THONKP1
1USB-BUSB-B-MOLEX-1050170001P2
1WE173950378WE78IC8
1WM8731SSOP28IC4

Similar boards

  • 4 layers100 × 100 mmESP32-Eurorack Audio, the printed circuit board in 3D

    ESP32-Eurorack Audio

    ctag-fh-kiel/esp32-eurorack-audio

    Open source eurorack audio module based on ESP32

    173 parts71
  • 4 layers63.2 × 42.9 mmEspLora, the printed circuit board in 3D

    EspLora

    RafaelEstevamReis/MonitoramentoRios

    Repositório do projeto de monitoramento de Rios

    49 parts2MIT
  • 2 layers150.5 × 127 mmEurorack engine, the printed circuit board in 3D

    Eurorack engine

    sinneb/esp32-hvcc

    Heavy compiler (hvcc) sources running on ESP32-DevKitC powered eurorack module

    81 parts29
  • 2 layers183 × 128.7 mmTT, the printed circuit board in 3D

    TT

    seismicindustries/TT

    Terminal Tedium alternative HW

    210 parts7
  • 2 layers177.5 × 82.5 mmMain controller, the printed circuit board in 3D

    Main controller

    enemonsieur/TIMS_analyses

    Analyses of TIMS stimulation + EEG for Characterization.

    127 parts
  • 4 layers95 × 95 mmAPEX v0, the printed circuit board in 3D

    APEX v0

    NANDHA0804/Apex-Diagnostic-Tool-V1

    Hardware design and manufacturing files for Project Apex V1.0: a multi-functional diagnostic tool. Features a custom 4-layer PCB architecture driven by an ESP32 master and ATmega328P co-processor for high-performance…

    146 parts
  • 2 layers20 × 108 mmGio, the printed circuit board in 3D

    Gio

    funkfinger/gio

    A 2 HP Eurorack generative arpeggiator module built around the Seeed XIAO RP2350. Produces scale-quantised V/Oct pitch CV and gate outputs driven by a probability-layered generative engine.

    58 parts

Questions

How big is the Strampler redesign v2 2 PCB?

It measures 91.3 × 108 mm and has 2 copper layers, 1.6 mm thick.

What parts does the Strampler redesign v2 2 use?

174 parts, built around the CP2102N-EK, ESP32-WROVER-B, MCP6004-E/P and TL072. The full list of its parts is on this page, with links to each part's symbol and footprint where PCBKit's library has them.

Where can I download the Strampler redesign v2 2 KiCad files?

From the tungusk/strampler-build-pack repository on GitHub, at the commit this page was made from: the board is hardware-kicad/project/Strampler_redesign_v2_2.kicad_pcb and its schematic hardware-kicad/project/Strampler_redesign_v2_2.kicad_sch. PCBKit opens the board in the browser, with nothing to install.

Can I use the Strampler redesign v2 2 design in my own project?

Its repository states no licence, so its author keeps all rights: ask tungusk before reusing the design.