
Slimsplaydy both
jusdisgi/slimsplaydy
Super slim 34-key ergonomic split keyboard with splay and stagger, using Kailh PG1316S Switches.

Super slim 34-key ergonomic split keyboard with splay and stagger, using Kailh PG1316S Switches.
Slimsplaydy panel is an open-source printed circuit board by jusdisgi, from the jusdisgi/slimsplaydy repository on GitHub. It is a 2-layer board of 153.6 × 193.5 mm with 184 parts on 48 nets, routed with 243 tracks and 97 vias.
It belongs with the keyboards and input boards and the nRF52 and nRF5x boards of this library.
Panelize the routed slimsplaydy halves for JLCPCB. This is the scripted pipeline ported
from LightFury (which proved out the by-hand merge + kikit fab --assembly path was a dead end).
The per-half boards (slimsplaydy_left/right.kicad_pcb) are the source of truth; everything below
rebuilds the combined board, panel, and CPL/BOM from them, so re-run it any time a half changes.
Supersedes the old "Option B / KiCad Append Board" plan and the hand-merged
slimsplaydy_both*files. Don't use those.
Per-half outline ≈ 122.5 × 97.3 mm. The halves stack vertically, interlocked — the lower
half's top peak tucks into the upper half's battery-slot notch — so the nest is much tighter than a
flat side-by-side. Tune PITCH_MM / XOFF_MM in merge_both.py from the first KiKit preview.
Environment: use the KiCad Command Prompt (so python = KiCad's Python with pcbnew).
KiKit's kikit.exe installs to ...KiCad\9.0\3rdparty\Python311\Scripts, which isn't on PATH by
default — add it for the session before the kikit commands:
set PATH=%PATH%;C:\Users\hunte\Documents\KiCad\9.0\3rdparty\Python311\Scriptscd slimsplaydy
# 1. Merge the two halves -> slimsplaydy_both.kicad_pcb. Right-half refs get a _2 suffix,
# nets get L_/R_ prefixes so the halves stay electrically distinct. Vertical interlocked
# nest, no rotation/tilt (every part is already on a whole degree). Replaces the by-hand
# merge. ALSO drops 8 kikit:Tab annotations so the panelizer puts tabs exactly where we want.
# Tune PITCH_MM / XOFF_MM / TAB_ANNOTATIONS in the script from the Step-2 preview.
python panel/merge_both.py
# 2. Frame it into a panel (full frame; tabs come from the annotations, see preset note below).
kikit panelize -p panel/slimsplaydy_panel.json slimsplaydy_both.kicad_pcb panel/slimsplaydy_panel.kicad_pcb
# 3. Export GERBERS from panel/slimsplaydy_panel.kicad_pcb (open in pcbnew -> Fabrication Toolkit
# plugin, or KiCad Plot). Use the toolkit for GERBERS ONLY — NOT `kikit fab jlcpcb --assembly`
# (it needs a schematic the panel's _2 refs can't match) and NOT the toolkit's own CPL/BOM.
# 3b. Copy the toolkit's gerber zip up into the canonical order folder:
cp panel/production/slimsplaydy_panel.zip production-panel/
# 4. Generate the CPL + BOM from the SAME panel file, straight into production-panel/.
python panel/gen_cpl.py panel/slimsplaydy_panel.kicad_pcb production-panel
# 5. LOCAL verification — open these and check BEFORE uploading.
python panel/render_cpl.py panel/slimsplaydy_panel.kicad_pcb production-panel/positions.csv panel/verify
# verify_overview.png : every red dot must sit on a pad cluster, none off-board
# verify_parts.png : every red ring at body center; orange star = our pin-1Upload to JLC: the three files in ../production-panel/ — slimsplaydy_panel.zip +
positions.csv + bom.csv (and attach SlimSplaydy_BlindSlot_Both.png to the order notes).
Full CPL/BOM rules + the one-time JLC rotation pass live in CPL_WORKFLOW.md.
../production-panel/ — the canonical JLC upload set (gerber zip + bom.csv + positions.csv
panel/production/ — Fabrication Toolkit scratch (gitignored, overwritten each run). Not for ordering.panel/verify/ — local placement-check PNGs from render_cpl.py.../old_cruft/ — superseded test-order files (Production_JLCPCBA/, the May production/,
retired cpl_build/, REVIEW-KICKOFF.md). Kept for reference; don't fab from them.Per half: 17× PG1316S (S1–S17), CONN1 Molex Pico-EZmate, PWR1 power switch, RST1
reset switch. LCSC: EZmate C505023, power C2911519, reset C79174, PG1316S consigned
C9900170245. Excluded (not placed): MCU1 nice!nano (DNP / hand-soldered), MH1–15 (NPTH
mounting holes), MAG1 (magsafe silk only). gen_cpl.py already enforces all of this.
Positions are exact (origin = body center = JLC datum). The only thing board geometry can't tell us is how JLC's library part is oriented vs our footprint. Resolve it in a single clean pass — read JLC's exact values, don't nudge:
C505023), PWR1 (C2911519), RST1
(C79174) — read whether it needs 0/90/180/270°.ROT_CORR in gen_cpl.py, keyed by LCSC, then re-run steps 4–5 (positions are
unaffected) and re-upload. C79174 = 90 and C2911519 = 90 are carried over from LightFury (same
ceoloide footprints) as starting points — still confirm them. C505023 starts at 0
(un-confirmed). PG1316S (C9900170245) starts at 0.If a part's body ever looks off its pads (not just rotated), add POS_OVERRIDE[lcsc] = (dx, dy)
in part-local mm. None expected.
The 0.8 mm back pocket for the steel MagSafe ring is ordered at JLC, not in the design files —
add it to the order notes / drawing as before
(Production_JLCPCBA/SlimSplaydy_BlindSlot_Both.png). At 0.8 mm depth F.Cu is untouched; B.Cu was
hand-routed clear of the ring — keep it clear on any re-route.
slimsplaydy_panel.json: annotation tabs + full frame + mouse-bites. fixed/spacing
tabs distribute blindly and land on the battery-slot openings (and spacing errors on concave
outlines); annotation tabs put a tab exactly at each kikit:Tab marker. Rails 5 mm, mouse-bite
0.5 mm drill @ 0.8 mm, tooling 1.52 mm, fiducials 1 mm copper / 2 mm opening, 1 mm mill radius,
JLCJLCJLCJLC order token, origin tl.merge_both.py (UPPER_TABS + LOWER_TABS): 10 tabs, each half held on
3 sides — upper: top (2) + right (2) + left (GreenL); lower: left (2) + bottom (2) + right
(GreenR). Every tab is half→frame; there are NO half-to-half tabs (fewest connections, and
each cut is cleanly two-sided). They clear both battery slots and flank both MCU slots. Six sit on
convex bounding-box edges (short tabs); GreenL/GreenR reach the concave upper-left / lower-right
edges and are necessarily longer, because KiKit's partition line follows the bounding box.
LOWER_TABS auto-shift with the nest, so they stay on the lower half when you change
PITCH_MM/XOFF_MM. To retune: edit a list (each entry is (x_mm, y_mm, into-board direction E/N/W/S)), re-run step 1, re-preview. If a tab doesn't appear, flip its direction 180° — the
ray pointed the wrong way. You can also drop kikit:Tab footprints by hand in KiCad (lib must be
literally kikit; add a text field KIKIT: width: 3mm).slimsplaydy_both as ONE board with two
disjoint outlines and auto-adds a tab joining the two pieces at their single closest approach
(independent of our annotations) — it shows up as a one-sided-cut bridge at the right shoulder of
the tuck. The fix is separation: PITCH 85 / XOFF −17 opens the nearest approach to ~6.6 mm
(right shoulder ~7.6 mm, was 3.5 mm at PITCH 82) so KiKit leaves them apart. Tuck is still ~12 mm.
(This also clears the 2 mm router = 2 × post.millradius with room to spare.) If KiKit still
stitches them at this gap, the definitive fix is the multiboard route — a kikit:Board
annotation per half so KiKit treats them as two separate boards and never joins them.merge_both.py: PITCH_MM (vertical center-to-center; smaller = deeper tuck =
shorter panel, but watch the nearest-approach so KiKit doesn't stitch) and XOFF_MM (slide the
lower half: more negative opens the right shoulder, less negative opens the left). Currently 85 / −17.LCSC fields are filled and pushed to the PCBs, so the BOM carries
part numbers. Verified: gen_cpl.py reads C505023 / C2911519 / C79174 / C9900170245 straight off
the boards.slimsplaydy_panel.kicad_pcb generation. If you
re-panelize, re-export both — never mix generations.| Qty | Value | Footprint | References |
|---|---|---|---|
| 102 | NPTH | NPTH | KiKit_MB_10_1, KiKit_MB_10_2, KiKit_MB_10_3, KiKit_MB_10_4, KiKit_MB_10_5, KiKit_MB_11_2, KiKit_MB_11_3, KiKit_MB_11_4, KiKit_MB_11_5, KiKit_MB_11_6, KiKit_MB_11_7, KiKit_MB_12_2, KiKit_MB_12_3, KiKit_MB_12_4, KiKit_MB_12_5, KiKit_MB_12_6 +86 |
| 34 | PG1316S | PG1316S | S1, S10, S10_2, S11, S11_2, S12, S12_2, S13, S13_2, S14, S14_2, S15, S15_2, S16, S16_2, S17 +18 |
| 30 | ceoloide:mounting_hole_npth | MH1, MH1_2, MH2, MH2_2, MH10, MH10_2, MH11, MH11_2, MH12, MH12_2, MH13, MH13_2, MH14, MH14_2, MH15, MH15_2 +14 | |
| 8 | Fiducial | Fiducial | KiKit_FID_B_1, KiKit_FID_B_2, KiKit_FID_B_3, KiKit_FID_B_4, KiKit_FID_T_1, KiKit_FID_T_2, KiKit_FID_T_3, KiKit_FID_T_4 |
| 2 | magsafe | MAG1, MAG1_2 | |
| 2 | Battery Connector | Connector_Molex:Molex_Pico-EZmate_78171-0002_1x02-1MP_P1.20mm_Vertical | CONN1, CONN1_2 |
| 2 | Power SW | ceoloide:power_switch_smd_side | PWR1, PWR1_2 |
| 2 | Reset SW | ceoloide:reset_switch_smd_side | RST1, RST1_2 |
| 2 | nice_nano | ceoloide:mcu_nice_nano | MCU1, MCU1_2 |

jusdisgi/slimsplaydy
Super slim 34-key ergonomic split keyboard with splay and stagger, using Kailh PG1316S Switches.

jusdisgi/slimsplaydy
Super slim 34-key ergonomic split keyboard with splay and stagger, using Kailh PG1316S Switches.

jusdisgi/slimsplaydy
Super slim 34-key ergonomic split keyboard with splay and stagger, using Kailh PG1316S Switches.


QuantumVillage/UncutGem
A prototype Full Stack fully Open Source NV Center Diamond Magnetometer

heiso/macrolev
Macrolev is an open source analog keyboard powered by Hall Effect switches

MetalMusings/MyOwnEtherCATDevice
Documentation accompanying the "Make My Own EtherCAT device" video serie on Youtube.

kbx81/ClimateSprinklerController
ESP32-based climate and sprinkler controller for use with ESPHome



relic-se/PicoSynth_Sandbox-hardware
Raspberry Pi Pico digital synthesizer board with I2S stereo audio i/o, MEMS microphones, MIDI i/o, a capacitive keybed, 1602 display, 2 rotary encoders, and LiPo battery. Designed for use with CircuitPython and synthio.
It measures 153.6 × 193.5 mm and has 2 copper layers, 1.6 mm thick.
184 parts. The full list of its parts is on this page, with links to each part's symbol and footprint where PCBKit's library has them.
From the jusdisgi/slimsplaydy repository on GitHub, at the commit this page was made from: the board is panel/slimsplaydy_panel.kicad_pcb and its schematic slimsplaydy_left.kicad_sch. PCBKit opens the board in the browser, with nothing to install.
Its repository states no licence, so its author keeps all rights: ask jusdisgi before reusing the design.