Skip to the content
4 layers50 × 70 mmStm32-portable data logger, the printed circuit board in 3D

Portable STM32L433 data logger, 50 × 70 mm, four layers, microSD, USB-C LiPo charging. Designed with copperhead. Never built: do not order expecting it to work.

Size
50 × 70 mm
Copper layers
4
Thickness
1.6 mm
Parts
90
Nets
87
Pads
354
Tracks, vias
956, 213
Pours
8
Routed
Yes
KiCad
KiCad 10.0 (file 20260206)
Created
4 Oct 2026
Updated
4 Oct 2026

Overview

Stm32-portable data logger is an open-source printed circuit board by copperheadhq, from the copperheadhq/copperhead-stm32-data-logger repository on GitHub. It is a 4-layer board of 50 × 70 mm with 90 parts on 87 nets, routed with 956 tracks and 213 vias.

It is built around the STM32L433RCT6, BME280 and SHT40-AD1F-R2, with the W25Q128JVSIQ, TPD2E2U06DRLR-TP and USBLC6-2SC6 among its other parts. Its parts include 30 resistors, 28 capacitors, 11 ICs, 5 connectors and 4 diodes. It belongs with the sensors and measurement and power boards and the STM32 boards of this library.

Main components

12

README

README.md

STM32 Portable Data Logger DL-A

A pocket data logger designed to run for months on one LiPo cell. An STM32L433 records temperature, humidity, pressure and motion to a microSD card, and USB-C charges the cell and shows the card to a PC. 50 × 70 mm, four layers, one button, two LEDs, a Qwiic port for more sensors, no radio.

⚠ This board has never been built

  • Never fabricated, never powered, no firmware. Nothing here has been tested on real hardware.
  • Every part number is unverified. All 85 purchased parts are marked UNVERIFIED in docs/BOM.md by their own author; none was checked against a distributor or datasheet. 21 of the 28 capacitors have no voltage rating stated.
  • The silkscreen is not finished. All 90 DRC findings are silkscreen: 40 overlaps and 50 texts clipped by mask, mostly reference designators never moved off their parts.
  • 6 schematic-parity warnings. H1 to H4, J5 and TP1 are marked "exclude from BOM" on the board but not in the schematic.
  • Below the design's own layout targets (measured from the board file):
    • SD_CMD and SD_D1 are 6.4 and 7.0 mm longer than SD_CLK (target: within 5 mm). Every SD line has two vias (target: one).
    • Power tracks (VBUS, VBAT, VSYS) are 0.45 to 0.6 mm for most of their length, 0.8 mm for 20 of their 146 mm, and 0.25 mm at the fine-pitch pins (target: 0.8 mm). The charger draws at most 475 mA in USB mode, but its ILIM resistor allows about 0.97 A if firmware selects that mode on a 1.5 A USB-C source (OPEN-3 in docs/SPEC.md).
    • The isolation slot around the temperature and humidity sensor is not cut. Only the planes under it are removed.
  • Not ready to order. The fab files in fab/ have not been DFM-checked or opened in a Gerber viewer. Placement rotations are uncorrected. The surface finish is not chosen, and nobody has confirmed that JLCPCB's economic assembly takes this 4-layer board.
  • ERC in the statistics is not the design's ERC. docs/BOARD-STATS.md lists 15 ERC violations. That count is raw KiCad ERC on a copy without the vendored symbol cache, so the 9 lib_symbol_mismatch are artefacts of the copy. The other 6 (pin_to_pin) are intended: each is listed, with its reason, under ercExclusions in hardware/schematic.intent.json. With those applied, ERC is clean. KiCad does not read that file, so ERC run on hardware/ reports those 6.

Passing ERC and DRC means the copper matches the schematic and a rule set. It is not evidence that the circuit works.

The board (a render, not a photograph)

The circuit

Schematic

  • Power: a 1S LiPo on a JST-PH connector and a TI BQ24075 power-path charger. A firmware-held latch makes the button a true on/off switch.
  • USB: USB 2.0 full speed, with ESD protection on the data lines.
  • Sensors: temperature and humidity (SHT40), pressure (BME280) and an accelerometer (LIS3DH).
  • Storage: the microSD card on a 4-bit SDMMC bus, plus 16 MB of NOR flash.
  • Interface: a Qwiic connector, one button, a green and a red LED, and SWD on Tag-Connect pads.

The design documents are in docs/:

The board

From docs/BOARD-STATS.md:

  • Size: 50 x 70 mm, 1.6 mm thick.
  • Stackup: four copper layers. F.Cu and B.Cu carry signals; In1.Cu and In2.Cu are solid ground planes.
  • Parts: 90 footprints, 84 of them SMD and all on the top.
  • Routing: 213 vias (0.3 mm drill), 87 nets, 0.2 mm minimum track.

The custom design rules are in hardware/stm32-portable-data-logger.kicad_dru:

  • no vias on the crystal nets
  • 0.5 mm from the crystal and USB nets to every other net but ground
  • nothing but the crystal nets and ground inside the crystal's guard ring

Bottom

Layout of this repository

text
hardware/   KiCad project: schematic, board, design rules, vendored symbol library
docs/       design documents, board statistics, schematic as PDF and SVG
fab/        gerbers, drill, BOM and CPL (read the warning in that folder)
images/     renders of the board, not photographs
3d/         STEP, GLB and STL models
LICENSES/   full text of the licences below

Building it

  1. Open: use KiCad 10.0.4 or later on hardware/stm32-portable-data-logger.kicad_pro. The schematic's symbols are vendored in hardware/sym-lib-cache/ (through sym-lib-table), so it opens without extra libraries.

  2. Fab files: read fab/2026-10-04-UNVERIFIED/README.md first. It says how the files were made, which changes were made to the generated output (the two inner layers were added), and what has not been checked.

  3. Before ordering anything:

    • verify every part number and rating
    • finish the silkscreen
    • open the gerbers in a viewer and run the fab's DFM check
    • choose the surface finish
    • check the placement preview for rotations
  4. 3D models: KiCad's 3D library has no model for six of the footprints (J1, J2, J3, U1, U7, SW1).

    • Renders: images/ shows close stand-ins from the same library: a GCT USB4105 for J1, a JST PH-K for J2, a Hirose DM3D for J3, WQFN-16 for U1, WSON-6 for U7, a TL3342 for SW1.
    • 3D files: 3d/ is exported from hardware/ as it is, so those six parts have no body there.

    Use the models for fit, not tolerance.

Licence

WhatLicence
Hardware: everything under hardware/, fab/ and 3d/CERN-OHL-S-2.0 (strongly reciprocal)
Documentation and images: docs/, images/, README.mdCC-BY-4.0

Full texts are in LICENSES/. See LICENSE for the per-directory statement.

Trademarks are not licensed. The copperhead mark on the silkscreen is a trademark; the licences above cover the design, not the mark. If you fabricate a modified board, remove it.

No warranty. CERN-OHL-S-2.0 sections 8 and 9 apply: no warranty, no liability.

Parts

90
QtyValueFootprintReferences
11100nFCapacitor_SMD:C_0402_1005MetricC8, C9, C10, C14, C15, C21, C22, C23, C24, C25, C26
51uFCapacitor_SMD:C_0603_1608MetricC1, C5, C6, C12, C28
547kResistor_SMD:R_0603_1608MetricR15, R16, R17, R18, R19
410uFCapacitor_SMD:C_0805_2012MetricC2, C3, C11, C20
41MResistor_SMD:R_0603_1608MetricR10, R11, R28, R29
44.7kResistor_SMD:R_0603_1608MetricR22, R23, R24, R25
4M3MountingHole:MountingHole_3.2mm_M3H1, H2, H3, H4
3100kResistor_SMD:R_0603_1608MetricR8, R12, R13
3100nFCapacitor_SMD:C_0603_1608MetricC4, C7, C16
310kResistor_SMD:R_0603_1608MetricR14, R21, TH1
21nFCapacitor_SMD:C_0402_1005MetricC19, C27
22N7002Package_TO_SOT_SMD:SOT-23Q2, Q4
25.1kResistor_SMD:R_0603_1608MetricR1, R2
26.8pFCapacitor_SMD:C_0402_1005MetricC17, C18
2AO3401APackage_TO_SOT_SMD:SOT-23Q1, Q3
2TPS22917DBVRPackage_TO_SOT_SMD:SOT-23-6U3, U4
11.2kResistor_SMD:R_0603_1608MetricR27
11.6kResistor_SMD:R_0603_1608MetricR6
1104031-0811Connector_Card:microSD_HC_Molex_104031-0811J3
110MResistor_SMD:R_0603_1608MetricR9
110nFCapacitor_SMD:C_0402_1005MetricC13
13.0kResistor_SMD:R_0603_1608MetricR5
132.768kHzCrystal:Crystal_SMD_3215-2Pin_3.2x1.5mmY1
133RResistor_SMD:R_0603_1608MetricR20
133kResistor_SMD:R_0603_1608MetricR3
1470RResistor_SMD:R_0603_1608MetricR26
1600RInductor_SMD:L_0805_2012MetricFB1
168kResistor_SMD:R_0603_1608MetricR7
182kResistor_SMD:R_0603_1608MetricR4
1BAT54CPackage_TO_SOT_SMD:SOT-23D2
1BME280Package_LGA:Bosch_LGA-8_2.5x2.5mm_P0.65mm_ClockwisePinNumberingU8
1BQ24075RGTRPackage_DFN_QFN:VQFN-16-1EP_3x3mm_P0.5mm_EP1.68x1.68mmU1
1KT-0603GLED_SMD:LED_0603_1608MetricD3
1KT-0603RLED_SMD:LED_0603_1608MetricD4
1LIS3DHTRPackage_LGA:LGA-16_3x3mm_P0.5mm_LayoutBorder3x5yU9
1S2B-PH-SM4-TBConnector_JST:JST_PH_S2B-PH-SM4-TB_1x02-1MP_P2.00mm_HorizontalJ2
1SHT40-AD1F-R2Sensor_Humidity:Sensirion_DFN-4_1.5x1.5mm_P0.8mm_SHT4x_NoCentralPadU7
1SM04B-SRSS-TBConnector_JST:JST_SH_SM04B-SRSS-TB_1x04-1MP_P1.00mm_HorizontalJ4
1SMAJ6.0ADiode_SMD:D_SMAD1
1STM32L433RCT6Package_QFP:LQFP-64_10x10mm_P0.5mmU5
1TC2030Connector:Tag-Connect_TC2030-IDC-NL_2x03_P1.27mm_VerticalJ5
1TPTestPoint:TestPoint_Pad_D1.0mmTP1
1TPD2E2U06DRLRPackage_TO_SOT_SMD:SOT-553U11
1TPS7A0233PDBVRPackage_TO_SOT_SMD:SOT-23-5U2
1TS-1187A-B-A-BButton_Switch_SMD:SW_Push_1P1T_XKB_TS-1187ASW1
1TYPE-C-31-M-12Connector_USB:USB_C_Receptacle_HRO_TYPE-C-31-M-12J1
1USBLC6-2SC6Package_TO_SOT_SMD:SOT-23-6U10
1W25Q128JVSIQPackage_SO:SOIC-8_5.3x5.3mm_P1.27mmU6

Similar boards

  • 4 layers30 × 30 mmController, the printed circuit board in 3D

    Controller

    andrewsharmon/rp2350-stepper-controller

    Low-cost 10-axis sine-microstepping controller for small steppers on the RP2350 (PIO + DMA). WIP.

    63 partsMIT
  • 4 layers90 × 100 mmSkylark usb, the printed circuit board in 3D

    Skylark usb

    naturalhazardscience/groundlark

    Open source hardware for community-powered citizen science

    132 partsMIT
  • 4 layers50.8 × 22.9 mmEos feather rp2040, the printed circuit board in 3D

    Eos feather rp2040

    embeddedos-org/eCAD-Hardware-Products

    Hardware designs + EE docs + Board datasheets of Multiple products

    56 parts8MIT
  • 4 layers69.8 × 35.2 mmNerdYcontroller, the printed circuit board in 3D

    NerdYcontroller

    KidsLabDe/GamePadPico

    Lamp-PCB for kidslab.

    123 parts5
  • 2 layers50 × 50 mmStarter, the printed circuit board in 3D

    Starter

    vaknin/PCB

    Hardware ideas to fab-ready PCBs as code: Rust pcbgen on KiCad 10, Freerouting, ESP-IDF firmware with QEMU/Wokwi simulation, CadQuery enclosures

    37 parts
  • 6 layers84 × 98 mmFujiNet-5200-Rev0, the printed circuit board in 3D

    FujiNet-5200-Rev0

    FujiNetWIFI/fujinet-hardware

    Schematics and design files for FujiNet hardware

    145 parts142
  • 4 layers100 × 75 mmFreedo radio, the printed circuit board in 3D

    Freedo radio

    CappyT/freedo

    Local coordinator for tado V3+ heating devices, with a Home Assistant integration and add-on

    135 parts33Apache-2.0
  • 4 layers60 × 31 mmGarageDoor pro, the printed circuit board in 3D

    GarageDoor pro

    nikolaus018/garageDoor-pro

    ESP32-C3 + GPS board that opens the garage door when you leave and arrive: firmware, KiCad PCB and perfboard build

    46 parts1MIT

Questions

How big is the Stm32-portable data logger PCB?

It measures 50 × 70 mm and has 4 copper layers, 1.6 mm thick.

What parts does the Stm32-portable data logger use?

90 parts, built around the STM32L433RCT6, BME280, SHT40-AD1F-R2 and W25Q128JVSIQ. The full list of its parts is on this page, with links to each part's symbol and footprint where PCBKit's library has them.

Where can I download the Stm32-portable data logger KiCad files?

From the copperheadhq/copperhead-stm32-data-logger repository on GitHub, at the commit this page was made from: the board is hardware/stm32-portable-data-logger.kicad_pcb and its schematic hardware/stm32-portable-data-logger.kicad_sch. PCBKit opens the board in the browser, with nothing to install.

Can I use the Stm32-portable data logger design in my own project?

Its repository states no licence, so its author keeps all rights: ask copperheadhq before reusing the design.