Skip to the content
4 layers80 × 70 mmStm32, the printed circuit board in 3D

Custom STM32F446ZET6 development board in KiCad. Prototype hardware, design review and validation log; hardware testing pending.

Size
80 × 70 mm
Copper layers
4
Thickness
1.6 mm
Parts
69
Nets
135
Pads
356
Tracks, vias
1,178, 226
Pours
3
Routed
Yes
KiCad
KiCad 10.0 (file 20260206)
Created
16 Oct 2026
Updated
22 Oct 2026

Overview

Stm32 is an open-source printed circuit board by ackom-a-o, from the ackom-a-o/stm32f446-development-board repository on GitHub. It is a 4-layer board of 80 × 70 mm with 69 parts on 135 nets, routed with 1,178 tracks and 226 vias.

It is built around the STM32F446ZET6, USBLC6-2SC6 and CC0805KRX7R9BB104, with the CL21B105KBFNNNE, B3F-1000 and CL21B225KAFVPJE among its other parts. Its parts include 29 capacitors, 15 resistors, 8 connectors, 5 diodes and 4 ICs. It belongs with the microcontroller boards boards and the STM32 boards of this library.

Main components

12

README

README.md

STM32F446 Development Board

A custom, USB-powered development board for sensor and control experiments, built around the STM32F446ZET6. This project follows an embedded hardware design from component selection and PCB layout through assembly preparation, firmware and bench validation.

Current milestone: prototype fabrication preparation. The corrected design, fabrication exports and assembly data are published below. Hardware is not yet bench-tested; final assembler production-file approval and physical validation remain open.

Current PCB top copper and silkscreen

Composed from the current fabrication Gerbers. Top copper and silkscreen only; drill holes are not depicted. This is a design view, not an assembled-board photograph.

Schematic PDF · Engineering review · Validation evidence · Manufacturing package · First power-up

What the board provides

AreaImplementation
MCUSTM32F446ZET6, Arm Cortex-M4, LQFP-144
PCB80 × 70 mm, four copper layers, nominal 1.6 mm
PowerUSB 5 V → protection → TPS7A2533 regulator → TPS22918 load switch → 3.3 V
ConnectivityUSB 2.0 full-speed device, SPI, I²C, UART, analog and GPIO headers
CAN expansionClassical CAN 2.0B on J7: PD0/RX and PD1/TX; requires an external 3.3 V logic-compatible transceiver
DebugExternal SWD probe through a custom five-pin header
Clock8 MHz crystal
User controlsThree pushbuttons and three indicator LEDs

USB host operation, USB Power Delivery and motor-power delivery are outside the current scope. The load switch controls rail startup; it is not a programmable current limiter.

mermaid
flowchart LR
    USB[USB-C 5 V] --> Protection[Fuse and series diode]
    Protection --> LDO[TPS7A2533 regulator]
    LDO --> Switch[TPS22918 load switch]
    Switch --> Rail[3.3 V MCU and headers]
    Host[USB host data] <--> ESD[USBLC6 protection]
    ESD <--> MCU[STM32F446]
    Probe[External SWD probe] <--> MCU
    MCU <--> IO[SPI / I2C / UART / GPIO]
    MCU <--> CANHeader[J7: PD0 RX / PD1 TX]
    CANHeader <--> Transceiver[External CAN transceiver - required]
    Transceiver <--> CANBus[CANH / CANL bus]

CAN uses the MCU's existing CAN1 controller through J7 pin 3 (PD0/CAN1_RX) and pin 4 (PD1/CAN1_TX), configured as AF9. The transceiver and bus termination are external to this PCB. This is Classical CAN, not CAN FD, and firmware/link testing is pending.

Engineering work behind the layout

The layout was reviewed against MCU and power-component datasheets, ST's USB hardware guidance and published signal-integrity advice. Checks covered electrical connectivity, local bypassing, ground return paths, USB geometry, reset/crystal placement, sourcing, footprint fit and assembly orientation. The engineering review records the reasoning, corrections, references and remaining limits.

  • Reset routing: moving C22 reduced its MCU reset route from 19.45 mm to 13.41 mm, about 31%. The before/after comparison records the improvement and remaining compromise.
  • Power margin: a 250 mA total design budget was screened against regulator dropout and dissipation. It remains conditional until load and thermal measurements establish the board's operating envelope.
  • Local bypassing: C29 adds a dedicated 1 µF capacitor at the TPS22918 input instead of relying only on the regulator's more distant output capacitor.
  • Ground return: a short PG9 inner-layer crossing was moved to the top layer to restore local ground beneath SWDIO. Ground stitching was retained; a geometric screen found no missing reference samples along the checked outer-layer routes.
  • Routing corners: the remaining ordinary PF6 right-angle bend was replaced with chamfered routing. The saved-board audit found zero ordinary track-to-track 90° bends within its stated scope. Why prefer 45° bends? They reduce abrupt geometry changes; a right angle alone does not prove a signal will fail.
  • Assembly data: the supplier preview exposed header and chip rotation mismatches. Corrections were put into the placement file, uploaded and checked after a full quote reload.

Peer feedback and AI-assisted checks supported these iterations. Bench measurements will be reported separately from calculations and software checks.

Evidence and next milestone

Recorded checks on 22 October 2026 report 0 ERC issues, 0 DRC violations, 0 unconnected items and 0 schematic parity issues, with no ignored checks or current exclusions. The published inventory contains 66 assembly references, plus three PCB test points. Validation evidence links the source hashes, reports and geometric checks; these do not establish measured hardware performance.

The fabricator has confirmed the nominal JLC04161H-7628 construction used as the design basis. Next: approve final production files and bring up the prototype. The bring-up checklist starts with inspection, shorts and power rails, then SWD/reset, clock startup, GPIO and USB. Every physical test in the test log remains not tested. Firmware will be added when implementation begins.

Explore the design

Open stm32.kicad_pro in KiCad 10, with its standard libraries installed.

The four-sheet schematic separates power, USB/debug/clock, peripheral interfaces and expansion. The MCU uses eight symbol units so that supply pins and GPIO ports can be reviewed separately. Named signals connect sheets; pin numbers retain their physical package mapping.

MCU ports and peripheral interface schematic

Sheet 3 of 4. The earlier readability refactor preserved its then-current 68 physical references and all 135 nets; historical comparison evidence records unchanged PCB geometry for that refactor. The subsequent C29 addition brings the current physical-reference count to 69.

FilesPurpose
stm32.kicad_schRoot sheet: power path and MCU supplies
usb_debug_clock.kicad_schUSB, clock, reset, boot and SWD
mcu_interfaces.kicad_sch, gpio_expansion.kicad_schMCU ports, peripheral headers and expansion
stm32.kicad_pcbRouted four-layer PCB
stm32.kicad_druProject design rules
STM32_Custom.pretty, STM32_Power.kicad_sym, STM32_MCU.kicad_symLocal footprints, power symbols and split MCU symbol
fp-lib-table, sym-lib-tableProject-relative library configuration
docs/Schematic export, design decisions, part inventory and validation evidence

Local libraries are included. The empty Library.pretty directory is retained for the existing project library table. The prototype-r3 package contains Gerbers/drills, BOM, supplier-adjusted placement data and file hashes. It is an unvalidated prototype package, not a production-qualified release. Placement rotations are supplier-specific; another assembler must check its own conventions.

References and licensing

STM32F446 datasheet · TPS7A25 datasheet · TPS22918 datasheet

A project hardware/documentation license has not yet been selected. No explicit open-source license is currently granted. Third-party assets remain subject to their respective licenses.

Parts

69
QtyValueFootprintReferences
17100nFCapacitor_SMD:C_0805_2012MetricC3, C4, C5, C6, C7, C8, C10, C11, C12, C13, C15, C17, C19, C21, C22, C27 +1
610kΩResistor_SMD:R_0805_2012MetricR1, R9, R12, R13, R14, R15
31KΩResistor_SMD:R_0805_2012MetricR6, R7, R8
31µFCapacitor_SMD:C_0805_2012MetricC16, C18, C20
3SW_Push_OpenButton_Switch_THT:SW_PUSH_6mm_H4.3mmSW1, SW2, SW3
22.2uFCapacitor_SMD:C_0805_2012MetricC1, C2
222pF C0GCapacitor_SMD:C_0805_2012MetricC23, C24
24.7kΩResistor_SMD:R_0805_2012MetricR10, R11
25.1kΩ 1%Resistor_SMD:R_0805_2012MetricR2, R3
11µFCapacitor_SMD:C_0603_1608MetricC29
12.2uF 25V X7RCapacitor_SMD:C_0805_2012MetricC26
12.2uF25VX7RCapacitor_SMD:C_0805_2012MetricC25
133kΩ,1%Resistor_SMD:R_0805_2012MetricR4
13V3TestPoint:TestPoint_Pad_D2.0mmTP2
14.7nFCapacitor_SMD:C_0805_2012MetricC28
14.7uFCapacitor_SMD:C_0805_2012MetricC14
1500mAFuse:Fuse_1812_4532MetricF1
182kΩ,1%Resistor_SMD:R_0805_2012MetricR5
18MHzCrystal:Crystal_SMD_Abracon_ABM3-2Pin_5.0x3.2mmY1
1ANALOG_3V3Connector_PinHeader_2.54mm:PinHeader_1x04_P2.54mm_VerticalJ6
1ESDA7P120-1U1MSTM32_Custom:ESDA7P60-1U1MD4
1EXPANSION_3V3Connector_PinHeader_2.54mm:PinHeader_2x10_P2.54mm_VerticalJ8
1GNDTestPoint:TestPoint_Pad_D2.0mmTP1
1GPIO_DConnector_PinHeader_2.54mm:PinHeader_1x10_P2.54mm_VerticalJ7
1GreenLED_SMD:LED_0805_2012MetricD1
1I²C1Connector_PinHeader_2.54mm:PinHeader_1x04_P2.54mm_VerticalJ3
1LED1LED_SMD:LED_0805_2012MetricD2
1LED2LED_SMD:LED_0805_2012MetricD3
1SPI1Connector_PinHeader_2.54mm:PinHeader_1x06_P2.54mm_VerticalJ4
1SS14Diode_SMD:D_SMAD5
1STM32F446ZETxPackage_QFP:LQFP-144_20x20mm_P0.5mmU1
1SWDConnector_PinHeader_2.54mm:PinHeader_1x05_P2.54mm_VerticalJ1
1TPS22918DBVRSTM32_Custom:TPS22918_DBV0006AU4
1TPS7A2533DRVRSTM32_Custom:TPS7A25_DRV0006AU3
1UART2_3V3Connector_PinHeader_2.54mm:PinHeader_1x03_P2.54mm_VerticalJ5
1USBLC6-2SC6Package_TO_SOT_SMD:SOT-23-6U2
1USB_5VTestPoint:TestPoint_Pad_D2.0mmTP3
1USB_C_Receptacle_USB2.0_16PSTM32_Custom:USB_C_Receptacle_USB4105_JLCJ2

Similar boards

  • 4 layers58 × 70 mmProbelab, the printed circuit board in 3D

    Probelab

    enkhbold470/kicad-projects

    Five KiCad 10 boards (4- and 6-layer): ESP32-S3 industrial gateway, USB-C PD bench supply, RP2040 logic analyzer, FOC motor controller, iCE40 FPGA board.

    88 partsCERN-OHL-S-2.0
  • 4 layers101.6 × 53.3 mmXc2064-mega shield, the printed circuit board in 3D

    Xc2064-mega shield

    swittlich/prjfreeman

    Open-source flow (yosys + nextpnr) and bitstream documentation for the XC2064, the first FPGA

    80 partsISC
  • 4 layers50 × 70 mmRp569, the printed circuit board in 3D

    Rp569

    kelu124/rp569

    RP569 - PIOs to usb3 ( rp2350 x ch569 )

    146 parts3
  • 2 layers51.4 × 61 mmCart, the printed circuit board in 3D

    Cart

    psobot/musicboy

    A high-quality audio playback cartridge for Nintendo® Game Boy® and Game Boy Color®.

    20 parts53MIT
  • 4 layers177 × 152.1 mmAvboard smt, the printed circuit board in 3D

    Avboard smt

    clydeshaffer/gametank

    design files for the gametank hardware implementation

    158 parts150
  • 2 layers20 × 160 mmZibs Saber v2, the printed circuit board in 3D

    Zibs Saber v2

    PedroBMedeiros/PolySaber

    Firmware for Cal Poly Senior Project - PolySaber a Custom PCB Soundboard

    75 parts
  • 6 layers160 × 145 mmMes main board, the printed circuit board in 3D

    Mes main board

    jmh8231-Dev/mes-main-board

    STM32MP257 Embedded Main Board

    736 parts3

Questions

How big is the Stm32 PCB?

It measures 80 × 70 mm and has 4 copper layers, 1.6 mm thick.

What parts does the Stm32 use?

69 parts, built around the STM32F446ZET6, USBLC6-2SC6, CC0805KRX7R9BB104 and CL21B105KBFNNNE. The full list of its parts is on this page, with links to each part's symbol and footprint where PCBKit's library has them.

Where can I download the Stm32 KiCad files?

From the ackom-a-o/stm32f446-development-board repository on GitHub, at the commit this page was made from: the board is stm32.kicad_pcb and its schematic gpio_expansion.kicad_sch. PCBKit opens the board in the browser, with nothing to install.

Can I use the Stm32 design in my own project?

Its repository states no licence, so its author keeps all rights: ask ackom-a-o before reusing the design.