Skip to the content
2 layers85 × 56 mmVisionAid Carrier, the printed circuit board in 3D

VisionAid Carrier

silentaf/viswa_id1

It is the interface and safety-island board that sits on top of the Raspberry Pi 5 in the chest pod.

Size
85 × 56 mm
Copper layers
2
Thickness
1.6 mm
Parts
58
Nets
92
Pads
207
Tracks, vias
828, 60
Pours
2
Routed
Yes
KiCad
KiCad 9.0 (file 20241229)
Created
8 Oct 2026
Updated
22 Oct 2026

Overview

VisionAid Carrier is an open-source printed circuit board by silentaf, from the silentaf/viswa_id1 repository on GitHub. It is a 2-layer board of 85 × 56 mm with 58 parts on 92 nets, routed with 828 tracks and 60 vias.

It is built around the AMS1117-3.3, M2.5 and 1N4148W, with the AO3400A and SS14 among its other parts. Its parts include 18 resistors, 9 capacitors, 9 connectors, 5 diodes and 3 transistors.

Main components

5

README

design/electronics/README.md

VisionAid Carrier Board: Electronics Design (v0.1, design stage)

Status (8 Oct 2026):

  • Designed and verified in KiCad 9: ERC 0 violations; DRC 0 violations; 0 unconnected; schematic ↔ PCB parity 0 issues.
  • Not fabricated or tested yet. Every number below is a design value or target, not a measurement.

What this board does

It is the interface and safety-island board that sits on top of the Raspberry Pi 5 in the chest pod.

BlockPartsWhy it is designed this way
FPGA safety islandU1 Sipeed Tang Nano 9K (GW1NR-9, 27 MHz) on 2 × 24 socketsTimes all 3 ultrasonic echoes in parallel and drives the motors without the Pi. If Linux or the AI crashes, obstacle alerts continue (watchdog on PI_HB). Only 3.3 V-bank pins on the left header are used; the right-header pins marked _1V8 are on a 1.8 V bank and are unused.
Pi linkJ1 2 × 20 header → 40-way IDC ribbon → Pi GPIOUART (GPIO14/15) for status and config, GPIO17 = heartbeat to the FPGA, GPIO27 = fault from the FPGA, I²C (GPIO2/3) for the IMU.
PowerF1 500 mA PTC, U2 AMS1117-3.3, C1–C5, D1 SS145 V comes from the Pi header (the Pi is powered by a BIS-certified USB-C power bank). The PTC protects the Pi's 5 V rail if this board shorts. A separate 3.3 V regulator means the Pi's 3.3 V pins (1, 17) are deliberately not used. D1 stops back-feed when the Tang Nano's own USB-C is plugged in for programming.
SensorsJ2–J4 RCWL-1601 ultrasonic (left, right, head-level), J5 TF-Luna LiDAR (drop-offs), J8 MPU-6050 IMURCWL-1601 works at 3.3 V, so there is no level shifting. The TF-Luna takes 5 V but has 3.3 V UART logic. 100 Ω series resistors (R7–R14) limit fault current and ringing on the cables.
Haptics and alarmQ1–Q3 AO3400A, R1–R6, D2–D4, J6/J7 coin motors, BZ1 buzzerLogic-level MOSFETs (V_GS(th) ≤ 1.45 V) are switched directly by the FPGA's 3.3 V PWM. 100 kΩ pull-downs keep the motors off while the FPGA boots. Flyback diodes protect the MOSFETs. The motors (3 V coin ERMs) run from +3V3.
ButtonsJ9 (READ = OCR, MODE, QUIET), R15–R17 10 k pull-ups, C7–C9 100 nF10 k × 100 nF ≈ 1 ms RC filter, plus digital debounce in the FPGA.
Test pointsTP1–TP6 (+5V, +3V3, GND, US_L_ECHO, MOT_L_G, PI_HB)For the Stage 3 logic-analyser measurement of echo → motor-on latency and for power checks.

FPGA pin map (Tang Nano 9K, 3.3 V banks only)

SignalFPGA pinSignalFPGA pin
US_L_TRIG / ECHO25 / 26PI_TXD (FPGA RX) / PI_RXD (FPGA TX)40 / 35
US_R_TRIG / ECHO27 / 28PI_HB (heartbeat in)41
US_H_TRIG / ECHO29 / 30FPGA_FAULT_N (out to Pi)42
LIDAR_TX / LIDAR_RX33 / 34MOT_L_PWM / MOT_R_PWM / BUZZ_EN51 / 53 / 54
Clock 27 MHz (on module)52BTN_READ / MODE / QUIET55 / 56 / 57

Source: the Sipeed Tang Nano 9K official pin map (wiki.sipeed.com).

PCB

  • Outline: 85 × 56 mm, 2 layers, 1.6 mm FR-4. It has the same outline and M2.5 mounting holes as the Raspberry Pi 5, and is stacked above the Pi on 20 mm standoffs. Those clear the Pi's USB/Ethernet jacks and the active cooler; a standard HAT would hit them.
  • Layout:
    • The Tang Nano sits on 8.5 mm sockets, with its USB-C flush at the right edge for programming.
    • Low-profile SMD parts sit under the module, between the socket rows.
    • Sensor connectors are on the bottom edge (cables exit downward towards the sensor windows). Buttons, IMU and motor connectors are on the left edge.
  • Track rules:
    • 5 V and GND: 0.5 mm.
    • +3V3: 0.3 mm (about 250 mA total load).
    • Signals: 0.25 mm (minimum 0.15 mm, where the router necks down at pads).
    • Clearance 0.2 mm; vias 0.6/0.3 mm.
    • GND pours on both layers.
  • Routing: FreeRouting v2.5.0 completed 100 %, with 0 violations.

How the files are produced (reproducible)

All files are generated from scripts so every design decision is written down:

text
tools/kicad.sh python design/electronics/scripts/gen_library.py    # Tang Nano symbol + footprint
python3 design/electronics/scripts/gen_schematic.py                # schematic (.kicad_sch)
tools/kicad.sh kicad-cli sch export netlist -o design/electronics/VisionAid_Carrier.net design/electronics/VisionAid_Carrier.kicad_sch
tools/kicad.sh python design/electronics/scripts/gen_pcb.py        # outline, placement, nets
tools/kicad.sh python design/electronics/scripts/route_pcb.py      # FreeRouting + GND pours

Open the project in the KiCad GUI with tools/kicad.sh kicad design/electronics/VisionAid_Carrier.kicad_pro.

Outputs (outputs/)

FileContents
VisionAid_Carrier_schematic.pdf / .svgSchematic
VisionAid_Carrier_pcb_top.pdf / _bottom.pdfCopper and silkscreen plots
gerbers/Fabrication files (Gerber X2 + Excellon drill + drill map)
VisionAid_Carrier_BOM.csvBill of materials (on-board parts)
VisionAid_Carrier_pos.csvPick-and-place positions
VisionAid_Carrier.step3D model for the enclosure CAD
pcb_3d_top.png / pcb_3d_iso.pngBoard renders with component 3D models (Tang Nano 9K: simplified model in 3d/)
ERC_report.txt / DRC_report.txtVerification reports

Not on the PCB BOM (buy separately in Stage 3)

  • 2 × 1×24 female headers (2.54 mm, 8.5 mm tall) for the Tang Nano.
  • 40-way IDC ribbon cable with 2 sockets (≈ 10 cm).
  • 4 × M2.5 × 20 mm standoffs and screws.
  • JST-XH housings and crimps.
  • The sensors, motors and buttons themselves (see the implementation plan, §5).

Open items before fabrication (Stage 3)

  1. Measure the Tang Nano 9K header row spacing with calipers. The footprint uses 22.86 mm (0.9″), taken from a community footprint, not an official drawing.
  2. Confirm the ribbon length and the standoff height against the enclosure CAD.
  3. Check the AMS1117 dropout and temperature at the real load: 5 V → 3.3 V at ~250 mA ≈ 0.43 W in SOT-223.
  4. Review the board in the KiCad GUI: tidy silkscreen, then re-run DRC.

Parts

58
QtyValueFootprintReferences
11100RResistor_SMD:R_0603_1608MetricR1, R2, R3, R7, R8, R9, R10, R11, R12, R13, R14
5100nFCapacitor_SMD:C_0603_1608MetricC4, C6, C7, C8, C9
4M2.5MountingHole:MountingHole_2.7mm_M2.5H1, H2, H3, H4
3100kResistor_SMD:R_0603_1608MetricR4, R5, R6
310kResistor_SMD:R_0603_1608MetricR15, R16, R17
31N4148WDiode_SMD:D_SOD-123D2, D3, D4
3AO3400APackage_TO_SOT_SMD:SOT-23Q1, Q2, Q3
210uF 10VCapacitor_SMD:C_0805_2012MetricC2, C5
1+3V3TestPoint:TestPoint_Pad_D1.5mmTP2
1+5VTestPoint:TestPoint_Pad_D1.5mmTP1
11kResistor_SMD:R_0603_1608MetricR18
122uF 10V X5RCapacitor_SMD:C_1206_3216MetricC1
122uF tantCapacitor_Tantalum_SMD:CP_EIA-3528-21_Kemet-BC3
1500mA PTCFuse:Fuse_1206_3216MetricF1
15V active buzzerBuzzer_Beeper:Buzzer_12x9.5RM7.6BZ1
1AMS1117-3.3Package_TO_SOT_SMD:SOT-223-3_TabPin2U2
1ButtonsConnector_JST:JST_XH_B4B-XH-A_1x04_P2.50mm_VerticalJ9
1GNDTestPoint:TestPoint_Pad_D1.5mmTP3
1IMUConnector_JST:JST_XH_B4B-XH-A_1x04_P2.50mm_VerticalJ8
1MOT_L_GTestPoint:TestPoint_Pad_D1.5mmTP5
1Motor_LConnector_JST:JST_XH_B2B-XH-A_1x02_P2.50mm_VerticalJ6
1Motor_RConnector_JST:JST_XH_B2B-XH-A_1x02_P2.50mm_VerticalJ7
1PI_HBTestPoint:TestPoint_Pad_D1.5mmTP6
1PWR greenLED_SMD:LED_0603_1608MetricD5
1RPi5_GPIO_40pinConnector_PinHeader_2.54mm:PinHeader_2x20_P2.54mm_VerticalJ1
1SS14Diode_SMD:D_SMAD1
1TF-LunaConnector_JST:JST_XH_B4B-XH-A_1x04_P2.50mm_VerticalJ5
1Tang Nano 9KVisionAid:TangNano9K_ModuleU1
1US_HConnector_JST:JST_XH_B4B-XH-A_1x04_P2.50mm_VerticalJ4
1US_LConnector_JST:JST_XH_B4B-XH-A_1x04_P2.50mm_VerticalJ2
1US_L_ECHOTestPoint:TestPoint_Pad_D1.5mmTP4
1US_RConnector_JST:JST_XH_B4B-XH-A_1x04_P2.50mm_VerticalJ3

Similar boards

  • 2 layers60 × 47 mmAstro driver, the printed circuit board in 3D

    Astro driver

    rudnik275/astronaut-lamp

    Ночник «космонавт на луне» → нативное HomeKit-устройство на ESP32 + HAA: разбор родной платы, схема драйвера, конфиг, корпус

    51 parts
  • 2 layers180 × 100 mmKi pultforsterker main, the printed circuit board in 3D

    Ki pultforsterker main

    SebastianKristo/pult-forsterker

    Ett kort (180 × 100 mm, 2 lag) som erstatter alle modulene, og som i tillegg har USB-delingsswitch, to AUX-innganger som digitaliseres (så alt kan mikses), «smart relé» for strømmen til forsterkerdelen…

    264 partsMIT
  • 2 layers58 × 40 mmG29 flap xiao, the printed circuit board in 3D

    G29 flap xiao

    fdebrus/g29-exhaust-flap-controller

    Open-source controller for the exhaust flap of the BMW Z4 G29 M40i: open the flap on demand (even in Comfort mode) while keeping full factory behaviour the rest of the time.

    36 partsMIT
  • 4 layers65 × 56 mmSensor HAT, the printed circuit board in 3D

    Sensor HAT

    Eniemooo/Sensor-HAT

    Open-hardware indoor air sensor (CO2, VOC/NOx, T/RH, light, sound): HAT for Raspberry Pi or standalone with Seeed XIAO + ESPHome. KiCad 10.

    112 parts
  • 2 layers52 × 32 mmSar pager, the printed circuit board in 3D

    Sar pager

    KingCountySAR/iot-beepers

    Bringing back our favorite pager alarms for those late night callouts

    17 parts
  • 4 layers94 × 65 mmLink base brd, the printed circuit board in 3D

    Link base brd

    semtronik/link-hardware

    Open hardware for the Semtronik Link devices: ESP32-S3 base board, interface modules and enclosure. KiCad and Fusion sources, CERN-OHL-S v2.

    115 parts
  • 2 layers148.3 × 69 mmPlantPartner PCB1.0, the printed circuit board in 3D

    PlantPartner PCB1.0

    aboler/plant-partner

    Plant-Partner repo. for CEN4907c

    86 parts3
  • 4 layers64 × 59 mmDoorbell, the printed circuit board in 3D

    Doorbell

    gunnarbeutner/doorbell

    doorbell.kicadsch / doorbell.kicadpcb are the authoritative source — edit them in KiCad. build.sh never authors copper; it runs the checks KiCad's own DRC/ERC can't express and exports the fab outputs:

    119 parts1MIT

Questions

How big is the VisionAid Carrier PCB?

It measures 85 × 56 mm and has 2 copper layers, 1.6 mm thick.

What parts does the VisionAid Carrier use?

58 parts, built around the AMS1117-3.3, M2.5, 1N4148W and AO3400A. The full list of its parts is on this page, with links to each part's symbol and footprint where PCBKit's library has them.

Where can I download the VisionAid Carrier KiCad files?

From the silentaf/viswa_id1 repository on GitHub, at the commit this page was made from: the board is design/electronics/VisionAid_Carrier.kicad_pcb and its schematic design/electronics/VisionAid_Carrier.kicad_sch. PCBKit opens the board in the browser, with nothing to install.

Can I use the VisionAid Carrier design in my own project?

Its repository states no licence, so its author keeps all rights: ask silentaf before reusing the design.