Skip to the content
2 layers30 × 35 mmSC440 Preamp, the printed circuit board in 3D

SC440 Preamp

lk-ek/SC440_Preamp

SC440 OPA1678 microphone preamp

Size
30 × 35 mm
Copper layers
2
Thickness
1.6 mm
Parts
29
Nets
14
Pads
63
Tracks, vias
115, 6
Pours
37
Routed
Yes
KiCad
KiCad 10.99 (file 20260901)
Created
1 Oct 2026
Updated
2 Oct 2026

Overview

SC440 Preamp is an open-source printed circuit board by lk-ek, from the lk-ek/SC440_Preamp repository on GitHub. It is a 2-layer board of 30 × 35 mm with 29 parts on 14 nets, routed with 115 tracks and 6 vias.

It is built around the OPA1678IDRGR. Its parts include 10 resistors, 9 capacitors, 2 connectors and 1 IC. It belongs with the audio and music boards of this library.

Main components

1

README

README.md

SC440 OPA1678 microphone preamp

don't try this at home

Caveat: measurements show that the theoretical use for this preamp is a reduction of the noise floor by a whopping 0.2dB. The noise seems to come from either the capsule or the analog board.

So this is a nice flex mod as an exercise in analogue circuitry, but don't expect any quality gains from it at all.

Intro

A 5 V analog gain board for the t.bone SC 440 USB microphone. It sits between its original microphone/JFET board and USB/ADC board, AC-couples the signal, rebiases it around a buffered half-supply reference, and adds selectable gain. The aim is to use less gain in the following ADC stage. A reduction in overall recording noise depends on how much noise that stage contributes; microphone and original analog-board noise are amplified along with the signal.

Default in the current KiCad files: amplifier gain +10.10 dB, using R8 = 2.2 kΩ and R9 = 1 kΩ, with the C2 = 1 µF MLCC input option. C1, R1 and R2 are DNP. C9 = 330 pF is populated across R8.

The board outline is 30 × 35 mm, with 2 mm corner radii. PCB thickness in this project is 1.6 mm. Files were saved with KiCad 10.99 nightly; use a build that supports their file format.

Assembly choices

Gain: approximately 6, 8 or 10 dB

The non-inverting amplifier uses Av = 1 + R8/R9, with R9 fixed at 1 kΩ. Populate one R8 value; these are alternatives, not additional resistors.

VariantR8R9Voltage gainGainConcrete R8 example, Yageo thin film
6 dB1 kΩ1 kΩ2.0×+6.02 dBRT0805BRD071KL
8 dB1.5 kΩ1 kΩ2.5×+7.96 dBRT0805BRD071K5L
10 dB — CAD default2.2 kΩ1 kΩ3.2×+10.10 dBRT0805BRD072K2L

The table gives the amplifier gain. End-to-end gain from J2 pin 4 to J1 pin 4 is slightly lower: R4/R6 alone introduce about 0.086 dB attenuation. The unloaded AC model gives approximately 5.93 / 7.87 / 10.01 dB at 1 kHz for the default MLCC option. See SIMULATION_VALIDATION.md for both capacitor options and the 20 kHz results.

These parts are 0805, 0.1%, 25 ppm/°C, 0.125 W. Ordinary 1% resistors also work; thin film is preferred for R8/R9 for ratio stability and low excess noise. Thin film does not eliminate thermal noise. The lower resistance values reduce that contribution compared with the older 22 kΩ/10 kΩ pair.

Use 6 dB where input-level headroom matters most; 10 dB provides the greatest analog boost. For a fixed ADC clipping level, allowable microphone-board input amplitude is inversely proportional to the selected voltage gain. Reduce ADC gain to obtain comparable recording levels, then check loud speech and plosives. An analog booster does not increase the ADC's full-scale voltage.

C9 remains 330 pF for all three variants. Its feedback-network pole is approximately 482 kHz / 322 kHz / 219 kHz for 6 / 8 / 10 dB respectively. This reduces the ideal amplifier gain toward unity at high frequencies; it is not a filter whose gain falls to zero. Its calculated contribution at 20 kHz is only about −0.006 / −0.014 / −0.032 dB respectively, before other circuit roll-off.

Input coupling: MLCC or film

Choose exactly one of the following assemblies. The input resistor R4 and bias resistor R6 are unchanged for either option.

PartA — compact MLCC, CAD defaultB — film
C21 µF, 0805, X7R, ≥16 VDNP
C1DNP2.2 µF PET film, Faratronic C241J225J2SC000, 63 V, 5 mm pitch
R1, R2DNP0 Ω each, 0805
R41 kΩ1 kΩ
R6100 kΩ100 kΩ
Approximate input high-pass pole1.6 Hz0.72 Hz

The default path is C2 → R4 → IN_AC. The film path is R1 → C1 → R2 → R4 → IN_AC. Do not populate both coupling branches: the two capacitors would operate in parallel rather than select a single option.

Both coupling capacitors are non-polarized. Film avoids the ferroelectric voltage dependence and microphony of X7R, but takes more space. The MLCC option is the compact assembly; its effective capacitance depends on the exact part and bias. These differences do not by themselves establish an audible benefit in the complete microphone.

The film variant requires assembly changes only. If editing KiCad to represent that variant, mark C2 DNP and clear DNP on C1/R1/R2, then update the PCB from the schematic. C1/R1/R2 are currently excluded from simulation as well, so changing DNP flags alone is not sufficient to simulate the film path.

Bill of materials

Quantities below are per preamp PCB. They describe the current electrical values and footprints. Orderable examples are documented choices, not proof that those exact manufacturers are already installed. Equivalent parts must match value, dielectric/technology, package and mechanical clearance.

All SMD passives use 0805 hand-solder footprints. Resistor examples are 0.125 W. No special “audio-grade” electrolytics are needed. Prices and stock are intentionally not fixed in this BOM.

Common parts for all six gain/capacitor combinations

Ref.QtyValue / specificationPackage / assembly sideConcrete part or ordering specification
U11OPA1678 dual audio op-ampSOIC-8, 3.9 × 4.9 mm, 1.27 mm pitch; frontTexas Instruments OPA1678IDR; do not substitute VSSOP/SON versions
R3122 Ω, 1%0805; frontYageo RC0805FR-0722RL
R4, R921 kΩ; thin film, 0.1% recommended0805; frontYageo RT0805BRD071KL; thin film at R4 is optional
R5, R7210 kΩ, 1%0805; frontYageo RC0805FR-0710KL
R61100 kΩ, 1%0805; frontYageo RC0805FR-07100KL
R81Select 1 kΩ / 1.5 kΩ / 2.2 kΩ0805; frontSelect exactly one part from the gain table above
R101100 Ω, 1%0805; frontYageo RC0805FR-07100RL
C3147 µF, 16 V, ±20%, polarizedRadial, Ø5 × 11 mm, 2 mm pitch; frontAishi ERS1CM470D11OT, LCSC C160836, matching the schematic link
C4, C82100 nF, X7R, ±10%, ≥16 V0805; C4 front, C8 backExample: Murata GRM21BR71H104KA01L, 50 V
C5, C92330 pF, C0G/NP0, ±5%0805; frontExample: Murata GRM2165C2A331JA01D, 100 V
C6110 µF, 16 V, ±20%, polarizedRadial, Ø5 × 11 mm, 2 mm pitch; front, mount lying downChengx KM106M016D11RR0VH2FP0, LCSC C43799, matching the schematic link
C711 nF, C0G/NP0, ±5%0805; frontExample: Murata GRM2165C2A102JA01D, 100 V
J114-pin JST XH header to digital board2.50 mm, vertical/top-entry; backJST B4B-XH-A; RoHS/tinning suffix may be shown as (LF)(SN)
J214-pin male header to analog board2.54 mm, straight; back1×4, 0.64 mm square pins; cut from a standard strip; choose mating length to suit original socket and board spacing
TP1–TP55 PCB padsTest pads, no purchased component required1 × 1 mm THT pad, 0.5 mm drill; frontOptional fine wire for probing; not five additional headers

C4 and C8 are required bypass capacitors and are included in the BOM. Their previous exclusion flags have been cleared in the root schematic, PCB and synchronized AC schematic.

C3 alternative: Rubycon 35ZLH47MEFC5X11, 47 µF / 35 V, Ø5 × 11 mm, 2 mm pitch, LCSC C109390. It fits the nominal pad pitch/body diameter and is electrically suitable; ZLH is a low-impedance series, not a dedicated low-leakage series. The higher voltage rating is not necessary here. Low leakage is useful at VREF_RAW, but a standard good-quality aluminum electrolytic is sufficient for this application.

Add parts for exactly one input option

VariantRef.QtySpecificationConcrete example
A — MLCCC211 µF, X7R, ±10%, 0805, ≥16 VMurata GRM219R71E105KA88D, 25 V
B — filmC112.2 µF, PET, ±5%, 63 V, 5 mm lead pitchFaratronic C241J225J2SC000, LCSC C5372007
B — filmR1, R220 Ω links, 0805Yageo RC0805JR-070RL, or suitable solder bridges

The MLCC assembly has 14 SMD passives and two radial electrolytics. The film assembly has 15 SMD passives, two radial electrolytics and one film capacitor. Both also use U1, J1 and J2. Simulation sources and XREF1/XAMP1 are not physical parts to order.

Cable, original-board modification and mechanical supports

ItemQty per complete installationConcrete choice / notes
Additional digital-board header1JST B4B-XH-A, if replacing the original digital-board socket as described below; verify its hole spacing separately
Cable housings2JST XHP-4, 4 positions
Crimp contacts8JST SXH-001T-P0.6, for 22–28 AWG wire; use the matching crimp tooling, or a correctly wired premade XH cable
Cable conductors4Short flexible wires; verify pin-to-pin continuity rather than trusting wire colors
Replacement analog-board headerAs requiredStandard 2.54 mm 1×4 header; original connector relocation is part of the installation, not an extra gain-stage component
PCB-only support footprints2, optional mechanical populationTwo back-side 1×2, 2.54 mm pin sockets, currently both called REF**; their pads have no electrical nets. Select height to suit the original board or leave unpopulated if not needed for support

Part references: TI OPA1678 datasheet, JST XH datasheet, Yageo 2.2 kΩ RT specification, Yageo 1.5 kΩ RT specification, Yageo 1 kΩ RT specification, Murata MLCC catalog, including C0G parts, and Murata 100 nF specification. See FOOTPRINT_CHECK.md for the actual symbol/pad/device cross-check.

Connections and installation

Connector pinout

J1 is the digital-board connector; J2 is the analog-board connector. Both are installed on the back of this PCB. The two pitches differ: JST XH is 2.50 mm, the unshrouded analog header is 2.54 mm.

Pin numberJ2 — from analog boardJ1 — to digital boardConnection on this PCB
1GNDGNDDirect common ground
2LEDLEDDirect pass-through
3+5V+5VDirect pass-through; preamp supply branches through R3
4ANALOG_INPUTANALOG_OUTPUTThrough coupling capacitor, amplifier and R10; not direct

Use pad numbers, including the square pin-1 pad, rather than assuming a left-to-right order from a photograph. Back-side placement and mirrored views change the apparent order. Check the cable at both ends before connecting USB.

The intended installation mounts the daughterboard behind the original analog PCB. Remove/reposition the original analog-board pin headers to the opposite side to make the required board-to-board connection. Replace the original digital-board pin socket with a JST XH header and use a short 4-wire cable to J1. Verify actual original-board holes, mating parts and enclosure clearance before final soldering; the daughterboard files do not define those original board footprints.

Keep the existing series DC-blocking capacitor on the digital-board audio input. J1 pin 4 carries the amplified AC signal on a DC level near VREF. There is no output coupling capacitor on the daughterboard itself. The microphone's exact ADC-side connection must be checked on the physical digital board.

C6 needs to be mounted lying down in the intended enclosure. Its CAD model is a generic upright radial capacitor, so the 3D view is not the final assembly orientation. Preserve polarity, avoid stressing the lead seals, and keep the body/metalwork clear of exposed conductors. Check C3 and the optional C1 against available height too. C1 currently has no attached 3D model.

Circuit and test points

BlockActual parts / connectionsPurpose / approximate behavior
Supply filterR3 = 22 Ω; C6 = 10 µF and C8 = 100 nF from VCC_A to GNDFilters raw USB 5 V; ideal R3/C6 pole ≈723 Hz
Reference dividerR5 = 10 kΩ from VCC_A to VREF_RAW; R7 = 10 kΩ to GND; C3 = 47 µF and C4 = 100 nF to GNDApproximately VCC_A/2; divider/C3 pole ≈0.68 Hz
Reference bufferU1B: pin 5 at VREF_RAW, pins 6/7 at VREFLow-impedance reference for input bias and feedback
Input coupling / biasC2 or C1/R1/R2; R4 = 1 kΩ; R6 = 100 kΩ to VREFBlocks original-board DC and establishes the amplifier bias
Input RF filterR4 with C5 = 330 pF from IN_AC to GNDPole approximately 0.48 MHz for a low-impedance source; source impedance also matters
AmplifierU1A; R8 from PREAMP_OUT to FB, R9 from FB to VREFGain selected by R8/R9
Feedback HF shapingC9 = 330 pF parallel to R8Gradually reduces gain toward unity above the feedback pole
Output isolation / filterR10 = 100 Ω; C7 = 1 nF from ANALOG_OUTPUT to GNDIsolates capacitive cable/input load; ideal RC pole ≈1.59 MHz

These pole calculations describe individual networks, not the complete loaded frequency response. Cable/ADC loading and the op-amp's finite bandwidth also contribute. Do not add a large capacitor directly to the buffered VREF output without checking the buffer's capacitive-load stability; C3/C4 are on VREF_RAW.

Test padNetExpected DC with USB connected, no audio
TP1VCC_ARaw +5V minus the drop across R3; at least 4.5 V for OPA1678 operation
TP2VREF_RAWApproximately TP1/2
TP3VREFApproximately TP2
TP4PREAMP_OUTApproximately TP3
TP5GNDProbe reference

Raw USB voltage was reported above 4.9 V. At roughly 4.2 mA quiescent draw the 22 Ω resistor drops about 0.09 V; this is an estimate, not a minimum-voltage measurement at the IC. Check TP1 under operation. The input signal is centered near half supply; OPA1678 is not rail-to-rail at its inputs.

For commissioning, first check power and reference voltages, then compare recordings at equal final level with reduced ADC gain. Check clipping with loud speech/plosives and look for USB-related spurs. A valid rendering or simulated trace does not replace those measurements.

Views

The included images represent the saved default assembly (10 dB, MLCC).

Schematic

Schematic

PCB layout — front

Copper, front silkscreen and board outline.

PCB layout — front

PCB layout — back

Rear copper/silkscreen and board outline, mirrored as viewed from the back.

PCB layout — back

3D — front and back

DNP models are omitted. C6's generic upright model and C1's missing model mean these images do not establish enclosure fit for every assembly variant.

3D front 3D back

Simulation

There are two model paths. Both schematics and both reference netlists now use the current hardware topology and component references. The AC project was derived from the root schematic, with its AC-model properties, simulation annotations and project metadata adapted.

File / projectStatus in this revisionAppropriate use
Root SC440_Preamp.kicad_sch + .wbkCurrent root hardware values, including 2.2 kΩ/1 kΩ, R4/C5/C7/C9; default MLCC pathTransient / operating-point work after preparing the local TI model; not newly executed for this documentation update
AC_SIM/SC440_Preamp_AC.kicad_sch + .wbkCurrent root topology; self-contained AC model; workbook plots output gain/phaseCurrent unloaded small-signal response for the default 10 dB / MLCC assembly
SC440_Preamp_fallback.cirCurrent topology and references, including input/output filters and C9Transient fallback after preparing the TI model
AC_SIM/SC440_Preamp_AC_reference.cirCurrent topology and referencesStandalone AC analysis using the included model

The root schematic uses a local ngspice adaptation of TI's OPA167x TINA-TI Spice Model (SBOMAC5D). Download it from the TI OPA1678 product page, then run from the project root:

sh
python3 tools/prepare_ti_model.py ~/Downloads/sbomac5d.zip

This creates vendor/OPA167x_ngspice.LIB. The TI model is not shipped here. The converter recognizes the documented Final 1.6 source hash; syntax adaptation does not guarantee compatibility with every KiCad/ngspice version. The modified noise and protection cells are not vendor-accurate. Treat the prepared model as a simulation aid, not proof of measured noise or protection performance.

The AC model is project-authored and self-contained, with typical 114 dB open-loop gain and 16 MHz GBW. It does not model clipping, slew, noise or rail limits. Both AC files default to 10 dB / MLCC; change their R8/input assembly when investigating other variants. Cable and ADC loading are not modeled. See SIMULATION_SPLIT.md and AC_SIM/README.md. All six assembly variants were run with ngspice 42 using the included AC model. Results and validation limits are in SIMULATION_VALIDATION.md. Model setup details are in SIMULATION_MODEL.md.

Regenerating the README images

Save schematic and PCB changes in KiCad first. The generator reads the saved files, refills zones in a temporary PCB copy, exports each PCB side separately, and renders the 3D component sides with KiCad's top/bottom views.

Install Python, Pillow and Inkscape. From the project root:

sh
python3 -m venv .venv
source .venv/bin/activate
python -m pip install Pillow
python tools/regenerate_readme_images.py \
  --kicad-cli "/Applications/KiCad-nightly-260925/KiCad.app/Contents/MacOS/kicad-cli" \
  --inkscape "/Applications/Inkscape.app/Contents/MacOS/inkscape"

Those app paths are the current macOS example; adjust them for your installation. The script can discover common app/PATH locations automatically. Use --models-dir PATH if the installed 3D library cannot be resolved. It normally rejects missing model files; --allow-missing-models explicitly allows incomplete renders. DNP footprints' models are omitted automatically.

No KiCad source file is rewritten by the image generator. Images are staged and validated before replacement. The old combined PCB image reference, if present, is converted to front/back references in README.md only after successful exports. For more detail on PCB views, override --pcb-front-layers and --pcb-back-layers; fabrication/courtyard layers are omitted by default to keep these views readable.

Licensing and model redistribution

Project-authored content is GPL-3.0-only, except where separately noted: LICENSE.md, LICENSES/GPL-3.0-only.txt. No TI SPICE macro-model is included or relicensed. See THIRD_PARTY_NOTICES.md and vendor/README.md.

Parts

29
QtyValueFootprintReferences
5TestPointTestPoint:TestPoint_THTPad_D1.0mm_Drill0.5mmTP1, TP2, TP3, TP4, TP5
20Resistor_SMD:R_0805_2012Metric_Pad1.20x1.40mm_HandSolderR1, R2
2100nCapacitor_SMD:C_0805_2012Metric_Pad1.18x1.45mm_HandSolderC4, C8
210kResistor_SMD:R_0805_2012Metric_Pad1.20x1.40mm_HandSolderR5, R7
21kResistor_SMD:R_0805_2012Metric_Pad1.20x1.40mm_HandSolderR4, R9
2330pCapacitor_SMD:C_0805_2012Metric_Pad1.18x1.45mm_HandSolderC5, C9
1100RResistor_SMD:R_0805_2012Metric_Pad1.20x1.40mm_HandSolderR10
1100kResistor_SMD:R_0805_2012Metric_Pad1.20x1.40mm_HandSolderR6
110uCapacitor_THT:CP_Radial_D5.0mm_P2.00mmC6
11nCapacitor_SMD:C_0805_2012Metric_Pad1.18x1.45mm_HandSolderC7
11uCapacitor_SMD:C_0805_2012Metric_Pad1.18x1.45mm_HandSolderC2
12.2kResistor_SMD:R_0805_2012Metric_Pad1.20x1.40mm_HandSolderR8
12.2uSC440_Preamp:Faratronic_C241J225_P5.00mmC1
122RResistor_SMD:R_0805_2012Metric_Pad1.20x1.40mm_HandSolderR3
147uCapacitor_THT:CP_Radial_D5.0mm_P2.00mmC3
1ANALOG BOARDConnector_PinHeader_2.54mm:PinHeader_1x04_P2.54mm_VerticalJ2
1JST-XH 1x04 TO DIGITAL BOARDConnector_JST:JST_XH_B4B-XH-A_1x04_P2.50mm_VerticalJ1
1OPA1678IDRPackage_SO:SOIC-8_3.9x4.9mm_P1.27mmU1

The 27 most common of 29 parts.

Similar boards

  • 4 layers170 × 101 mmFreeDSP G, the printed circuit board in 3D

    FreeDSP G

    freeDSP/FreeDSP-G

    ADAU1467 DSP Board for Electric Guitar Players

    377 parts7CC0-1.0
  • 4 layers194 × 94 mmBottom board, the printed circuit board in 3D

    Bottom board

    mod-audio/hw-mod-dwarf

    Hardware project of MOD Dwarf

    319 parts6
  • 4 layers99.8 × 64 mmAudio Amp v1, the printed circuit board in 3D

    Audio Amp v1

    Loredati-svg/TPA3116D2-Class-D-Amplifier

    2×50W stereo Class-D audio amplifier based on TI TPA3116D2 – KiCad PCB design

    124 parts1
  • 4 layers300 × 270 mmTbox, the printed circuit board in 3D

    Tbox

    charlieh0tel/ee_stuff

    440 partsBSD-3-Clause
  • 2 layers234 × 58 mmPGA2311 3, the printed circuit board in 3D

    PGA2311 3

    dmsd-lab/AMP8611

    AMP8611 - open hardware integrated stereo power amplifier with a 2-channel input selector, PGA2311 digital volume control and LM3886 power stages

    213 partsCERN-OHL-S-2.0
  • 2 layers85 × 76 mmPedal, the printed circuit board in 3D

    Pedal

    GasimovDev/guitar-pedal

    A digital guitar pedal. Guitar in, an STM32 microcontroller runs three effects (overdrive, then tremolo, then delay), and the sound comes out to your amp. It has six knobs, three footswitches and three LEDs.

    106 parts
  • 4 layers192 × 315.1 mmAesa, the printed circuit board in 3D

    Aesa

    tieziyun/ultrasonic-aesa

    A 40 kHz in-air phased array, an acoustic "AESA". It has 64 transducers in an 8 × 8 grid, and each one can transmit or listen under FPGA control, element by element and ping by ping.

    2,139 parts
  • 2 layers94.5 × 44.5 mmCrow mic pod, the printed circuit board in 3D

    Crow mic pod

    misko/prompt2device

    The separate vNext PCB skill and orchestrator package is available alongside the reference workflow below; existing projects keep their accepted toolchain until an explicit migration.

    40 parts3MIT

Questions

How big is the SC440 Preamp PCB?

It measures 30 × 35 mm and has 2 copper layers, 1.6 mm thick.

What parts does the SC440 Preamp use?

29 parts, built around the OPA1678IDRGR. The full list of its parts is on this page, with links to each part's symbol and footprint where PCBKit's library has them.

Where can I download the SC440 Preamp KiCad files?

From the lk-ek/SC440_Preamp repository on GitHub, at the commit this page was made from: the board is SC440_Preamp.kicad_pcb and its schematic AC_SIM/SC440_Preamp_AC.kicad_sch. PCBKit opens the board in the browser, with nothing to install.

Can I use the SC440 Preamp design in my own project?

Its repository states no licence, so its author keeps all rights: ask lk-ek before reusing the design.