Skip to the content
2 layers29.3 × 26.2 mmBoard a, the printed circuit board in 3D

Toolkit for the BME-690 sensor array on a Bosch Application Board 3.1 shuttle board.

Size
29.3 × 26.2 mm
Copper layers
2
Thickness
1.6 mm
Parts
15
Nets
19
Pads
58
Tracks, vias
168, 5
Pours
2
Routed
Yes
KiCad
KiCad 10.0 (file 20260206)
Created
20 Sep 2026
Updated
26 Oct 2026

Overview

Board a is an open-source printed circuit board by leakydata, from the leakydata/bme690-toolkit repository on GitHub, published under the MIT licence. It is a 2-layer board of 29.3 × 26.2 mm with 15 parts on 19 nets, routed with 168 tracks and 5 vias.

Its parts include 4 capacitors, 4 resistors and 3 connectors.

README

board_a/README.md

Board A: Shuttle 3.0 breakout

A 29.3 x 26.2 mm board that takes any Bosch Sensortec Shuttle Board 3.0, including the BME690 8x shuttle, and brings all 16 of its pins out to a labelled 2.54 mm header for Dupont wires, a breadboard ribbon or a microcontroller.

top bottom

What's on it

partjob
J1shuttle sockets: P1 (7 pins) and P2 (9 pins), 1.27 mm. A 7-pin and a 9-pin socket, so the shuttle only fits one way
J22x8 2.54 mm header with every shuttle pin
J32 pins for measuring the sensor's VDD current (IDD)
R1, R24.7k I2C pull-ups on SDA and SCL, each behind a cut jumper
R31k pull-up on PROM_RW, the shuttle's ID chip
R410k pull-up on CS, so single-sensor shuttles start in I2C mode
C1-C4100 nF + 10 uF on VDD, and the same on VDDIO

3.3 V only. Never connect 5 V.

Header pin map (J2)

The column next to the shuttle carries its GPIO0-7, and the outer column carries power and the bus. Both sides of the board are labelled, and a dot marks pin 1.

rowinner pininner labelsignalouter pinouter labelsignal
110GPIO0 (P1-4)2VIOVDDIO (P1-2)
231GPIO1 (P1-5)4VDDVDD supply in
352GPIO2/INT1 (P1-6)6GNDGND (P1-3)
473GPIO3/INT2 (P1-7)8SCKSCK/SCL (P2-2)
594GPIO4 (P2-5)10SDOSDO (P2-3)
6115GPIO5 (P2-6)12SDISDI/SDA (P2-4)
7136GPIO6 (P2-7)14CSCS (P2-1)
8157GPIO7 (P2-8)16IDPROM_RW (P2-9)

On the BME690 8x shuttle, GPIO0-7 are the chip selects of sensors U1-U8, and CS (P2-1) isn't connected to anything. The 8x shuttle only works over SPI: in I2C mode all eight sensors would answer at the same address.

Solder jumpers

All four are closed as made. To open one, cut the thin trace between its pads with a sharp knife. To close it again, bridge the pads with solder.

jumperlabelopen it to
JP1IDD (bottom left of J3)measure sensor current: put a meter across J3
JP2TIEpower VDDIO separately from VDD (feed VIO yourself)
JP3SDAremove the 4.7k SDA pull-up
JP4SCLremove the 4.7k SCL pull-up

With TIE closed, one 3.3 V wire to VIO or VDD powers everything.

Which side for the header?

The header is hand-soldered, so you choose:

  • Pins down, on the back: best for sniffing jars. The sensors face the sample and the wires leave from the other side, so the plastic and wire insulation stay out of the air being measured.
  • Pins up, on the front: easiest on a bench.
  • Right-angle header: the wires leave sideways and the board lies flat. Its body covers the labels on that side, but the other side is labelled too.

To a breadboard: use a 16-way ribbon cable with a 2x8 IDC socket on one end and a 16-pin DIP IDC plug on the other. Put the red stripe at the pin-1 dot. The plug sits across the breadboard's centre gap. Its pins alternate between the two DIP rows, so check the plug's datasheet for which conductor lands where. A flat ribbon also passes a jar lid's seal far better than loose jumpers.

Assembly

JLCPCB fits the eight 0603 parts. You solder the through-hole parts.

  1. Check the board under a light: all eight SMD parts present, no bridges.
  2. Sockets first. Plug both sockets onto the shuttle and push the shuttle into the board. The shuttle holds the sockets straight and at the right spacing. Solder one end pin of each row, check they sit flat, then solder the rest. Remove the shuttle before it gets hot for long.
  3. 2x8 header on the side you chose. Solder one pin, check it's square, then the rest.
  4. J3 (optional), the same way.
  5. Check with a meter: 3V3 to GND must not be a short. VIO to VDD reads about 0 ohm (TIE closed).

Smoke test (ESP32-S3)

smoke_test/smoke_test.ino (Arduino IDE or arduino-cli, ESP32 core 3.x, board "ESP32S3 Dev Module"). The wiring matches the logger firmware's pin map, so a board wired for the logger runs the test unchanged.

Board AESP32-S3
VIO3V3
GNDGND
SCKGPIO12
SDIGPIO11
SDOGPIO13
0-7GPIO1, 2, 4, 5, 6, 7, 15, 16
  • MODE_SPI 1 (the default), for the 8x shuttle: reads the chip ID register of all eight sensors and expects 0x61 from each. A sensor that answers wrong names its chip-select wire.
  • MODE_SPI 0, for a single-sensor shuttle: scans I2C and reads register 0xD0 at 0x76. It drives SDO low to set that address, because SDO must not float. Expect 0x61. Leave CS open; the 10k pull-up selects I2C.

For the full logger, see firmware/bme690-logger-idf.

PROM_RW (shuttle ID): the DS28E05 talks at 1-Wire overdrive speed only (up to 76.9 kbps). The datasheet's overdrive timings are:

timingvalue
reset low48-80 us
presence sample8-10 us
write-0 low8-16 us
write-1 / read low1-2 us
sample by2 us
slot13 us minimum
EEPROM write16 ms per write

Common ESP32 1-Wire libraries run at standard speed and won't see it. A reader needs these timings, using the RMT peripheral or interrupt-free bit timing. It isn't in the smoke test yet.

Ordering at JLCPCB

All files are in fab/:

fileupload as
board_a-gerbers.zipthe PCB (Gerbers + Excellon drill)
board_a-bom-jlcpcb.csvPCB Assembly: BOM
board_a-cpl-jlcpcb.csvPCB Assembly: CPL / pick-and-place
board_a-bom-full.csvyour shopping list, including the hand-soldered parts
board_a-schematic.pdf, board_a-layout.pdffor checking

Board options:

optionsetting
layers2
thickness1.6 mm
materialFR-4
solder maskgreen
surface finishLeadFree HASL
Mark on PCBRemove Mark (free, and the default)
quantity5

Assembly options:

optionsetting
typeEconomic
sideTop
boards to assemble5 (or 2, the minimum)

Parts JLCPCB fits

All are LCSC Basic parts, so there is no extended-part fee. Stock was checked 2026-10-05.

partsvalueLCSCstock
R1, R24.7k 1% 0603C2316222.2 M
R31k 1% 0603C2119021.3 M
R410k 1% 0603C2580429.6 M
C1, C3100 nF X7R 50 V 0603C1466357.2 M
C2, C410 uF X5R 10 V 0603C1970210.3 M

Parts you buy and solder

Per board:

partqtyabout
Sullins LPPB071NFFN-RC, 7-pin 1.27 mm socket1$1.00
Sullins LPPB091NFFN-RC, 9-pin 1.27 mm socket1$1.20
2x8 male header, 2.54 mm (straight or right angle)1$0.30
1x2 male header, 2.54 mm (optional, for IDD)1$0.05

Cost estimate, 5 boards

These are estimates from JLCPCB's published prices (October 2026). The quote page gives the real figure.

bare PCBPCB + assembly
5 PCBs, 2-layer, under 100 x 100 mm$2$2
lead-free HASL surchargeabout $1-1.50about $1-1.50
assembly setup (Economic)-$8.18
stencil-$1.53
solder joints, 80 x $0.0016-$0.13
parts: 5 Basic lines, LCSC minimum quantities-about $0.50-1
extended-part fees-$0 (none)
subtotal before shippingabout $3-4about $13-15
US shipping, Global Standard Direct (slowest, cheapest)about $1.50-4about $2-5
US shipping, DHL / UPS / FedEx expressabout $15-25about $15-25
US import duty (DDP, pre-collected)a few dollarsa few dollars

Plus about $13 for the hand-soldered parts for 5 boards, with distributor shipping on top.

Duties. JLCPCB ships to US individuals DDP (Delivered Duty Paid): the import duty is calculated and charged at checkout, so nothing is due on delivery. It is mandatory for individual customers. Business accounts may choose CPT and pay duty themselves. JLCPCB revised its US rates on 2026-03-17, after the February 2026 tariff change. The exact amount appears on the checkout page.

Coupons.

  • When it applies: the coupon is chosen on the checkout / payment page, after you enter the shipping address. Available coupons are listed there, and a code (such as a YouTube sponsor code) goes in the coupon box on the right of the order summary.
  • One per order: only one coupon can be used per order, and coupons can't be combined. Pick the larger of your sponsor code and the new-customer coupon.
  • New-customer coupons: $6 off PCB orders over $2, or $10 off SMT assembly orders over $2, with shipping not counted toward the minimum. A separate $10 shipping coupon needs $15 of shipping.

Pre-order checklist

  1. Upload board_a-gerbers.zip. The viewer should show 29.3 x 26.2 mm, 2 layers and 39 holes, with the labels readable on both sides.
  2. Set LeadFree HASL, green, 1.6 mm, and leave "Mark on PCB" at Remove Mark.
  3. Turn on PCB Assembly: Economic, Top side, then upload the BOM and CPL.
  4. On the parts page, check that all 8 parts matched (5 lines, all "Basic") and nothing is marked "shortage".
  5. On the placement preview, check each part sits on its pads. R and C rotation doesn't matter (they aren't polarised), but each must sit squarely on both pads.
  6. Choose shipping and check the DDP duty line.
  7. Apply your coupon on the checkout page and check the total before paying.
  8. Order the sockets and headers from a distributor (Digi-Key, Mouser, LCSC) at the same time.

Design rules used

JLCPCB 2-layer capabilities (jlcpcb.com/capabilities, checked 2026-10-03), with these values used:

ruleusedJLCPCB minimum
clearance0.15 mm0.10 mm
minimum track0.15 mm (0.2 signal, 0.4 power)0.10 mm
vias0.6 mm pad, 0.3 mm hole0.25 / 0.15 mm
PTH annular ringat least 0.225 mm (sockets)0.18 mm (0.25 recommended)
copper to board edge0.3 mm0.2 mm
hole to hole0.5 mm0.45 mm
silkscreen text1.0 mm high, 0.15 mm line1.0 / 0.15 mm

ERC: 0 errors, 0 warnings. DRC, including warnings and schematic parity: 0.

Editing

Open board_a.kicad_pro in KiCad 10. build.py and pcb.py generated the first version: one parts list feeds both the schematic and the board, with Freerouting for the tracks. Once you edit in KiCad, keep editing there. Re-running the scripts overwrites your changes. The shared symbols and footprints are in ../shuttle_lib.

Parts

15
QtyValueFootprintReferences
2100nFCapacitor_SMD:C_0603_1608MetricC1, C3
210uFCapacitor_SMD:C_0603_1608MetricC2, C4
24.7kResistor_SMD:R_0603_1608MetricR1, R2
110kResistor_SMD:R_0603_1608MetricR4
11kResistor_SMD:R_0603_1608MetricR3
12x8 headerConnector_PinHeader_2.54mm:PinHeader_2x08_P2.54mm_VerticalJ2
1IDDJumper:SolderJumper-2_P1.3mm_Bridged_RoundedPad1.0x1.5mmJP1
1IDD meterConnector_PinHeader_2.54mm:PinHeader_1x02_P2.54mm_VerticalJ3
1SCL pull-upJumper:SolderJumper-2_P1.3mm_Bridged_RoundedPad1.0x1.5mmJP4
1SDA pull-upJumper:SolderJumper-2_P1.3mm_Bridged_RoundedPad1.0x1.5mmJP3
1Shuttle 3.0 socketsShuttle3:Bosch_Shuttle_3.0_SocketsJ1
1TIEJumper:SolderJumper-2_P1.3mm_Bridged_RoundedPad1.0x1.5mmJP2

More from leakydata/bme690-toolkit

1
  • 2 layers25.5 × 24.6 mmBoard b, the printed circuit board in 3D

    Board b

    leakydata/bme690-toolkit

    Toolkit for the BME-690 sensor array on a Bosch Application Board 3.1 shuttle board.

    16 partsMIT

Similar boards

  • 2 layers19 × 76 mmSub, the printed circuit board in 3D

    Sub

    google/mozc-devices

    Circuit diagrams and firmware source code for Gboard DIY keyboards

    15 parts3kApache-2.0
  • 2 layers26.7 × 62.2 mmDeniseadapter, the printed circuit board in 3D

    Deniseadapter

    hoglet67/RGBtoHDMI

    Bare-metal Raspberry Pi project that provides pixel-perfect sampling of Retro Computer RGB/YUV video and conversion to HDMI

    15 parts1kGPL-3.0
  • 2 layers100 × 44 mmVideoslot, the printed circuit board in 3D

    Videoslot

    mntmn/amiga2000-gfxcard

    MNT VA2000, an Open Source Amiga 2/3/4000 Graphics Card (Zorro II/III), written in Verilog

    15 parts1k
  • 2 layers91 × 51 mmBusinessCard, the printed circuit board in 3D

    BusinessCard

    hackclub/OnBoard

    💡 Join 1,000 teenagers and make your first PCB with a $100 grant!

    15 parts915
  • 2 layers24.3 × 57.9 mmFlosspods pro flex, the printed circuit board in 3D

    Flosspods pro flex

    kenp-io/not-for-airpods-repairs

    The content of this repository is licensed under the WTFPL License. Please have a close look at the terms before using this material.

    15 parts609WTFPL
  • 2 layers20.3 × 15.2 mmL0 Load, the printed circuit board in 3D

    L0 Load

    Luos-io/luos_engine

    Open-source and real-time orchestrator for cyber-physical-systems, to easily design, test and deploy embedded applications and digital twins.

    15 parts546MIT
  • 2 layers68 × 50 mmEleLab v2 PowerFeed, the printed circuit board in 3D

    EleLab v2 PowerFeed

    Chrismettal/EleLab_v2

    Cheap DIY lab system for hobbyists and the tinkering folk

    15 parts531GPL-3.0
  • 2 layers50.8 × 35.6 mmInterface, the printed circuit board in 3D

    Interface

    harbaum/I2C-Tiny-USB

    Cheap and simple I²C to USB interface

    15 parts454

Questions

How big is the Board a PCB?

It measures 29.3 × 26.2 mm and has 2 copper layers, 1.6 mm thick.

What parts does the Board a use?

15 parts. The full list of its parts is on this page, with links to each part's symbol and footprint where PCBKit's library has them.

Where can I download the Board a KiCad files?

From the leakydata/bme690-toolkit repository on GitHub, at the commit this page was made from: the board is board_a/board_a.kicad_pcb and its schematic board_a/board_a.kicad_sch. PCBKit opens the board in the browser, with nothing to install.

Can I use the Board a design in my own project?

Its repository publishes it under the MIT licence: you may reuse it on that licence's terms (keep the author's notice, and for a copyleft licence share your changes alike).