Skip to the content
2 layers130.5 × 79.3 mmSnap Adapter 17up 150x100, the printed circuit board in 3D

Snap Adapter 17up 150x100

Pluze/pcb

Reference and experimental KiCad PCB designs with reusable agent workflows

Size
130.5 × 79.3 mm
Copper layers
2
Thickness
1.6 mm
Parts
17
Nets
17
Pads
34
Tracks, vias
0, 17
Routed
Not yet
KiCad
KiCad 10.0 (file 20250610)
Created
16 Sep 2026
Updated
19 Sep 2026

Overview

Snap Adapter 17up 150x100 is an open-source printed circuit board by Pluze, from the Pluze/pcb repository on GitHub, published under the MIT licence. It is a 2-layer board of 130.5 × 79.3 mm with 17 parts on 17 nets.

It belongs with the interfaces and adapters boards of this library.

README

Designs/Electrode_Snap_Adapter_Series/README.md

Electrode Snap Adapter Series

This design family adapts circular thin-film electrodes to an exposed front copper pad intended for soldering a snap connector. Each board has one centered contact on each side and one centered drilled hole. The front contact is fixed at 8 mm; the back contact follows the thin-film electrode diameter.

The boards are intended for in-house fabrication on an LPKF U4. The machine does not create a plated barrel in this workflow, so the center hole is a manual interconnect: wick solder through the 1.0 mm drill to join the front and back copper, then verify continuity before attaching the film electrode.

Series

Variant fileFront snap padBack film-electrode padSquare boardLimiting copper-to-edge margin
Circular_Contact_F8_B5_S10.kicad_pcb8 mm5 mm10 mm1 mm
Circular_Contact_F8_B10_S18p75.kicad_pcb8 mm10 mm18.75 mm4.375 mm
Circular_Contact_F8_B15_S25.kicad_pcb8 mm15 mm25 mm5 mm
Circular_Contact_F8_B20_S30.kicad_pcb8 mm20 mm30 mm5 mm
VariantFrontBack
8/5/108 mm front pad on 10 mm board5 mm back pad on 10 mm board
8/10/18.758 mm front pad on 18.75 mm board10 mm back pad on 18.75 mm board
8/15/258 mm front pad on 25 mm board15 mm back pad on 25 mm board
8/20/308 mm front pad on 30 mm board20 mm back pad on 30 mm board

The 20/30 mm, 15/25 mm, and 10/18.75 mm pairs are taken from the centered circle/square geometry in electrode-size-test.dxf. The source also explicitly labels a 5 mm electrode but does not contain a completed centered square for it; the 10 mm minimum board requested for this project is therefore used for the 5 mm variant.

Geometry and fabrication contract

  • Substrate: double-sided copper-clad board suitable for the available LPKF U4 process.
  • Front: centered 8 mm exposed copper on F.Cu/F.Mask, with no paste aperture.
  • Back: centered 5, 10, 15, or 20 mm exposed copper on B.Cu/B.Mask, with no paste aperture.
  • Center interconnect: 2.0 mm copper diameter, 1.0 mm drilled hole, represented as the CONTACT via in KiCad.
  • Physical interconnect: solder must be wicked through the drilled hole because the in-house process does not plate it.
  • Outline: centered square from the table; no board side is less than 10 mm.
  • Silkscreen: intentionally absent from both contact regions.
  • Finish: bare copper or the finish available in the in-house process; clean and prepare the copper appropriately for the selected film-electrode attachment method.

The base project PCB is the largest 8/20/30 mm member. The four independently manufacturable family members are under variants/. The schematic is intentionally empty because this is a geometry-defined, single-net passive adapter.

150 x 100 mm material-efficient panel

panels/Snap_Adapter_17up_150x100.kicad_pcb places 17 adapters on one 150 x 100 mm raw FR4 sheet while retaining at least three copies of every family member. Finished outlines are separated by 2 mm:

  • first row: four 30 mm boards;
  • second row: four 25 mm boards and one 18.75 mm board;
  • third row: four 18.75 mm boards and four 10 mm boards.

This yields four 30 mm, four 25 mm, five 18.75 mm, and four 10 mm boards. The finished-board area is 8,257.8125 mm², or 55.05% of the raw material area, compared with 39.53% for exactly three of each. The 17 coupon-cut contours occupy a 129 x 77.75 mm bounding box. A single 130.5 x 79.25 mm processing boundary surrounds them with a 0.75 mm rail and is the only geometry on Edge.Cuts. CircuitPro's documented automatic-fiducial example uses 1.5 mm fiducials whose centers are 4 mm outside BoardOutline, so the corresponding outside envelope is 140 x 88.75 mm. Centering leaves 5 mm horizontally and 5.625 mm vertically from the fiducial outer edges to the material edges.

The dashed 150 x 100 mm stock outline and four expected fiducial circles in the KiCad panel are on Dwgs.User; they are visual planning aids only. The seventeen finished coupon contours are on User.1 (Coupon.Cuts) so they can be imported separately from the continuous BoardOutline. Import the five panel machine files, then let CircuitPro create the actual fiducials from BoardOutline at 4 mm distance. Do not assign Dwgs.User as a manufacturing layer.

FrontBack
Seventeen-adapter panel, frontSeventeen-adapter panel, back

These reader-facing previews show the seventeen finished coupons after separation. They are rendered from a temporary view-only copy that maps Coupon.Cuts to board outlines and omits the continuous processing rail; the manufacturing PCB and exported layer mapping remain unchanged.

LPKF ProtoLaser U4 fabrication files

The active build target is the 17-coupon panel under fabrication/u4/Snap_Adapter_17up_150x100/. Import its five machine files together: TopLayer.gtl → TopLayer, BottomLayer.gbl → BottomLayer, BoardOutline.gm1 → BoardOutline, CutInside.gm2 → CutInside, and DrillPlated.drl → DrillPlated. Keep the continuous processing outline separate from the 17 coupon contours. Use the qualified U4 recipe for complete copper removal and double-sided registration, then perform the non-plated center-hole solder operation described above. Standalone coupon sources are under variants/; the build publishes the panel as the active target.

LightBurn solder-mask templates

fabrication/lightburn/ contains millimetre DXF files generated from F.Mask or B.Mask together with Edge.Cuts. Import the DXF for the required side into LightBurn. Front files are top-view geometry; back files remain in KiCad board coordinates, so apply LightBurn's horizontal flip only when the chosen tape-transfer orientation requires it. Laser settings are intentionally not stored in these geometry files.

Regenerate the complete family

From the repository root:

sh
python3 tools/pcbflow/routing/scripts/generate_circular_contact_board.py \
  --csv Designs/Electrode_Snap_Adapter_Series/series.csv \
  --output-dir Designs/Electrode_Snap_Adapter_Series/variants \
  --via-diameter 2 \
  --via-drill 1 \
  --force

Regenerate the base project board:

sh
python3 tools/pcbflow/routing/scripts/generate_circular_contact_board.py \
  8 20 30 \
  --output-dir Designs/Electrode_Snap_Adapter_Series \
  --name Electrode_Snap_Adapter_Series \
  --via-diameter 2 \
  --via-drill 1 \
  --force

Regenerate the 17-adapter panel:

sh
python3 tools/pcbflow/routing/scripts/generate_circular_contact_panel.py \
  --csv Designs/Electrode_Snap_Adapter_Series/series.csv \
  --output Designs/Electrode_Snap_Adapter_Series/panels/Snap_Adapter_17up_150x100.kicad_pcb \
  --count-each 3 --gap 2 \
  --stock-width 150 --stock-height 100 \
  --fiducial-distance 4 --fiducial-diameter 1.5 --stock-edge-margin 5 \
  --processing-rail 0.75 \
  --row 30:4 \
  --row 25:4,18.75:1 \
  --row 18.75:4,10:4 \
  --via-diameter 2 --via-drill 1 \
  --force

Regenerate or audit the U4 and LightBurn manufacturing outputs directly from the KiCad PCB files:

sh
python3 tools/pcbflow/kicad/scripts/export_circuitpro_u4_packages.py \
  export Designs/Electrode_Snap_Adapter_Series --force
python3 tools/pcbflow/kicad/scripts/export_kapton_lightburn_templates.py \
  export Designs/Electrode_Snap_Adapter_Series --force

For another size, the only required geometry inputs remain FRONT_DIAMETER BACK_DIAMETER BOARD_SIDE. Keep the front value at 8 mm for this snap-connector family unless the connector changes.

Assembly

  1. Mill both copper patterns, drill the 1.0 mm center hole, and cut the square outline.
  2. Deburr and clean both copper surfaces without removing the narrow edge margin on the 10 mm board.
  3. Wick solder through the center hole until it wets both copper sides; avoid a large solder mound on the back where the film must sit flat.
  4. Measure low resistance between the front and back pads before attaching the film electrode.
  5. Attach the thin-film electrode concentrically to the matching back pad and solder the snap connector to the 8 mm front pad.

The 10 mm board has only 1 mm copper-to-edge margin around the 8 mm front pad. It meets the stated minimum size but is the least tolerant of cutter runout, registration error, and edge damage.

Supplier Gerbers and unified build

./pcb build --design Electrode_Snap_Adapter_Series refreshes U4, LightBurn DXF and fabrication/gerber/ together. Each supplier package includes all declared layers, the native Gerber job, PTH/NPTH drill files and PACKAGE.md with layer mapping and order parameters to confirm. For the complete saved-design routing workflow, use the repository tool guide.

Parts

17
QtyValueFootprintReferences
5FRONT_8mm_BACK_10mmCircular_Contact_AsymmetricJ9, J10, J11, J12, J13
4FRONT_8mm_BACK_15mmCircular_Contact_AsymmetricJ5, J6, J7, J8
4FRONT_8mm_BACK_20mmCircular_Contact_AsymmetricJ1, J2, J3, J4
4FRONT_8mm_BACK_5mmCircular_Contact_AsymmetricJ14, J15, J16, J17

More from Pluze/pcb

2

Similar boards

  • 2 layers50 × 35 mmServo power, the printed circuit board in 3D

    Servo power

    earthtojake/text-to-cad

    Design physical products with AI

    17 parts26kMIT
  • 2 layers139.7 × 62.2 mmBreakout 60pin EEC IV, the printed circuit board in 3D

    Breakout 60pin EEC IV

    rusefi/rusefi

    rusefi - GPL internal combustion engine control unit

    17 parts1.2k
  • 2 layers29.2 × 55.9 mmDeniseadapter, the printed circuit board in 3D

    Deniseadapter

    hoglet67/RGBtoHDMI

    Bare-metal Raspberry Pi project that provides pixel-perfect sampling of Retro Computer RGB/YUV video and conversion to HDMI

    17 parts1kGPL-3.0
  • 2 layers24.5 × 36.5 mmCluster, the printed circuit board in 3D

    Cluster

    JesusFreke/lalboard

    A 3D-printed keyboard inspired by the DataHand

    17 parts993
  • 2 layers56.3 × 55.7 mmStarNecklace, the printed circuit board in 3D

    StarNecklace

    hackclub/OnBoard

    💡 Join 1,000 teenagers and make your first PCB with a $100 grant!

    17 parts915
  • 2 layers25 × 25 mmSmallEncoder, the printed circuit board in 3D

    SmallEncoder

    DDeGonge/OS-ARM

    This arm is not industrial and it will not be fast, but that is not my goal. But it will hopefully be a very nice looking arm fully capable of 6dof motion, cheap enough to keep it accessable but capable enough to…

    17 parts498MIT
  • 2 layers38.9 × 16.1 mmAmoeba spc, the printed circuit board in 3D

    Amoeba spc

    mtl/keyboard-pcbs

    Keyboard PCBs

    17 parts485
  • 2 layers36 × 51 mmABSIS ALE, the printed circuit board in 3D

    ABSIS ALE

    jrsteensen/OpenHornet

    OpenHornet 1:1 F/A-18C Simulator Repository

    17 parts431

Questions

How big is the Snap Adapter 17up 150x100 PCB?

It measures 130.5 × 79.3 mm and has 2 copper layers, 1.6 mm thick.

What parts does the Snap Adapter 17up 150x100 use?

17 parts. The full list of its parts is on this page, with links to each part's symbol and footprint where PCBKit's library has them.

Where can I download the Snap Adapter 17up 150x100 KiCad files?

From the Pluze/pcb repository on GitHub, at the commit this page was made from: the board is Designs/Electrode_Snap_Adapter_Series/panels/Snap_Adapter_17up_150x100.kicad_pcb and its schematic Designs/Electrode_Snap_Adapter_Series/Electrode_Snap_Adapter_Series.kicad_sch. PCBKit opens the board in the browser, with nothing to install.

Can I use the Snap Adapter 17up 150x100 design in my own project?

Its repository publishes it under the MIT licence: you may reuse it on that licence's terms (keep the author's notice, and for a copyleft licence share your changes alike).